get

ParameterDefinition.get(par='', entity='', entnum='', item1='', it1num='', item2='', it2num='', **kwargs)

Retrieves a value and stores it as a scalar parameter or part of an array parameter.

Mechanical APDL Command: *GET

Parameters:

parstr

The name of the resulting parameter. See starset for name restrictions.

entitystr

Entity keyword. Valid keywords are NODE, ELEM, KP, LINE, AREA, VOLU, etc., as shown for Entity = in the tables below.

entnumstr

The number or label for the entity (as shown for ENTNUM = in the tables below). In some cases, a zero (or blank) ENTNUM represents all entities of the set.

item1str

The name of a particular item for the given entity. Valid items are as shown in the Item1 columns of the tables below.

it1numstr

The number (or label) for the specified Item1 (if any). Valid IT1NUM values are as shown in the IT1NUM columns of the tables below. Some Item1 labels do not require an IT1NUM value.

item2str

A second set of item labels and numbers to further qualify the item for which data are to be retrieved. Most items do not require this level of information.

it2numstr

A second set of item labels and numbers to further qualify the item for which data are to be retrieved. Most items do not require this level of information.

Notes

get retrieves a value for a specified item and stores the value as a scalar parameter, or as a value in a user-named array parameter. An item is identified by various keyword, label, and number combinations. Usage is similar to the starset command except that the parameter values are retrieved from previously input or calculated results.

Example: get Usage

get,A,ELEM,5,CENT,X returns the centroid x location of element 5 and stores the result as parameter A.

get command operations, and corresponding get functions, return values in the active coordinate system ( csys for input data or rsys for results data) unless stated otherwise.

A get function is an alternative in-line function that can be used instead of the get command to retrieve a value. For more information, see.

Both get and starvget retrieve information from the active data stored in memory. The database is often the source, and sometimes the information is retrieved from common memory blocks that the program uses to manipulate information. Although POST1 and POST26 operations use a *.rst file, get data is accessed from the database or from the common blocks. Get operations do not access the *.rst file directly. For repeated gets of sequential items, such as from a series of elements, see the starvget command.

Most items are stored in the database after they are calculated and are available anytime thereafter. Items are grouped according to where they are usually first defined or calculated. Preprocessing data will often not reflect the calculated values generated from section data. Do not use get to obtain data from elements that use calculated section data, such as beams or shells.

When the value retrieved by get is a component name, the resulting character parameter is limited to 32 characters. If the component name is longer than 32 characters, the remaining characters are ignored.

Most of the general items listed below are available from all modules. Each of the sections for accessing get parameters are shown in the following order:

• *GET General Entity Items

• *GET Preprocessing Entity Items

• *GET Solution Entity Items

• *GET Postprocessing Entity Items

The get command is valid in any processor.

General Items

*GET General Entity Items

• *GET General Items, Entity = ACTIVE

• *GET General Items, Entity = CMD

• *GET General Items, Entity = COMP

• *GET General Items, Entity = GRAPH

• *GET General Items, Entity = PARM

• *GET General Items, Entity = TBTYPE

*GET General Items, Entity = ACTIVE

Entity = ACTIVE, ENTNUM = 0 (or blank)

get, Par, ACTIVE, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
INT		Current interactive key: 0=off, 2=on.
IMME		Current immediate key: 0=off, 1=on.
MENU		Current menu key: 0=off, 1=on.
PRKEY		Printout suppression status: 0= nopr, 1= gopr or slashgo
UNITS		Units specified by units command: 0 = USER, 1 = SI, 2 = CGS, 3 = BFT, 4 = BIN, 5 = MKS, 6 = MPA, 7 = uMKS.
ROUT		Current routine: 0 = Begin level, 17 = PREP7, 21 = SOLUTION, 31 = POST1, 36 = POST26, 52 = AUX2, 53 = AUX3, 62 = AUX12, 65 = AUX15.
TIME	WALL,CPU	Current wall clock or CPU time. Current wall clock will continue to accumulate during a run and is not reset to zero at midnight.
DBASE	LDATE	Date of first modification of any database quantity required for POST1 operation. The parameter returned is Par = YEAR*10000 + MONTH*100 + DAY.
DBASE	LTIME	Time of last modification of any database quantity required for POST1 operation. The parameter returned is Par = HOURS*10000 + MINUTES*100 + SECONDS.
REV		Minor release revision number (5.6, 5.7, 6.0 etc.). Letter notation (for example, 5.0A) is not included.
TITLE	0,1,2,3,4	Item2: START IT2NUM: N Current title string of the main title ( IT1NUM =0 or blank) or subtitle 1, 2, 3, or 4 ( IT1NUM =1,2,3, or 4). A character parameter of up to 8 characters, starting at position N, is returned.
JOBNAM		Item2: START IT2NUM: N Current Jobname. A character parameter of up to 8 characters, starting at position N, is returned. Use dim and *DO to get all 32 characters.
PLATFORM		The current platform.
NPROC	CURR, MAX, MAXP	The number of processors being used for the current session, or the maximum total number of processors (physical and virtual) available on the machine, or the maximum number of physical processors available on the machine. This only applies to shared-memory parallelism.
NUMCPU		Number of distributed processes being used (distributed-memory parallel solution).

*GET General Items, Entity = CMD

Entity = CMD, ENTNUM = 0 (or blank) The following items are valid for all commands except star (2) commands and non-graphics slash (/) commands.

get, Par, CMD, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
STAT		Status of previous command: 0=found, 1=not found (unknown).
NARGS		Field number of last nonblank field on the previous command.
FIELD	2,3… N	Numerical value of the N th field on the previous command. Field 1 is the command name (not available)

*GET General Items, Entity = COMP

Entity = COMP, ENTNUM = 0 (or blank)

get, Par, COMP, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
NCOMP		Total number of components and assemblies currently defined.

*GET General Items, Entity = GRAPH

Entity =GRAPH, ENTNUM = N (window number)

get, Par, GRAPH, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
ACTIVE		Windowing operations status: 0=off, 1=on.
ANGLE		angle THETA angle.
CONTOUR	Name	contour value for Name, where Name = VMIN, VINC, or NCONT.
DIST		dist DVAL value.
DSCALE	DMULT	slashdscale DMULT value.
EDGE		edge KEY value.
FOCUS	X, Y, Z	focus CIN, YF, or ZF value.
GLINE		gline STYLE value.
MODE		NumPy user guide or auto setting: 0=user, 1=auto.
NORMAL		normal KEY value.
RANGE	XMIN, XMAX, YMIN, YMAX	Windowing operations XMIN, XMAX, YMIN, or YMAX screen coordinates.
RATIO	X, Y	ratio RATOX or RATOY value.
SSCALE	SMULT	sscale SMULT value.
TYPE		slashtype Type value.
VCONE	ANGLE	vcone PHI angle.
VIEW	X, Y, Z	View XV, YV, or ZV value.
VSCALE	VRATIO	vscale VRATIO value.

*GET General Items, Entity = PARM

Entity = PARM, ENTNUM = 0 (or blank)

get, Par, PARM, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
MAX		Total number of parameters currently defined.
BASIC		Number of scalar parameters (excluding parameters beginning with an underscore _, array parameters, and character parameters).
LOC	Num	Name of the parameter at the Num location in the parameter table. A character parameter is returned.

*GET General Items, Entity = TBTYPE

Entity = TBTYPE, ENTNUM = MatID (where TBTYPE is the material table type as defined via the tb command, such (ELASTIC, CTE, etc.), and MatID is the material ID) Evaluates a material property coefficient for a given set of input field variables.

get, Par, TBTYPE, MatID, Item1, IT1NUM, Item2, IT2NUM, Fld1, Fld2,…
Item1	IT1NUM	Description
TBEV: Material table evaluation for query at a given field variable	SINDEX = Subtable index (1 - max number of subtables)	Item2 : CINDEX = Coefficient index
		IT2NUM : N = Number of field variables input
		Fld1, Fld2, …, : Val = Value of the field variable(s), entered in the same order specified via the tbfield command(s)

Preprocessing Items

*GET Preprocessing Entity Items

• *GET Preprocessing Items, Entity = ACTIVE

• *GET Preprocessing items, Entity = AREA

• *GET Preprocessing Items, Entity = AXIS

• *GET Preprocessing Items, Entity = CDSY

• *GET Preprocessing Items, Entity = CE

• *GET Preprocessing Items, Entity = CMPB

• *GET Preprocessing Items, Entity = CP

• *GET Preprocessing Items, Entity = CSEC

• *GET Preprocessing Items, Entity = ELEM

• *GET Preprocessing Items, Entity = ETYP

• *GET Preprocessing Items, Entity = GCN

• *GET Preprocessing Items, Entity = GENB

• *GET Preprocessing Items, Entity = GENS

• *GET Preprocessing Items, Entity = KP

• *GET Preprocessing Items, Entity = LINE

• *GET Preprocessing Items, Entity = LINK

• *GET Preprocessing Items, Entity = MAT

• *GET Preprocessing Items, Entity = MPLAB

• *GET Preprocessing Items, Entity = NODE

• *GET Preprocessing Items, Entity = OCEAN

• *GET Preprocessing Items, Entity = OCZONE

• *GET Preprocessing Items, Entity = PART

• *GET Preprocessing Items, Entity = PIPE

• *GET Preprocessing Items, Entity = RCON

• *GET Preprocessing Items, Entity = REIN

• *GET Preprocessing Items, Entity = SCTN

• *GET Preprocessing Items, Entity = SECP

• *GET Preprocessing Items, Entity = SHEL

• *GET Preprocessing Items, Entity = TBFT

• *GET Preprocessing Items, Entity = TBLAB

• *GET Preprocessing Items, Entity = VOLU

*GET Preprocessing Items, Entity = ACTIVE

Entity = ACTIVE, ENTNUM = 0 (or blank)

get, Par, ACTIVE, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
SEG		Segment capability of graphics driver: 0=no segments available, 1=erasable segments available, 2=non-erasable segments available.
CSYS		Active coordinate system.
DSYS		Active display coordinate system.
MAT		Active material.
TYPE		Active element type.
REAL		Active real constant set.
ESYS		Active element coordinate system.
SECT		Active section.
CP		Maximum coupled node set number in the model (includes merged and deleted sets until compressed out).
CE		Maximum constraint equation set number in the model (includes merged and deleted sets until compressed out).

*GET Preprocessing items, Entity = AREA

Entity = AREA, ENTNUM = N (area number)

get, Par, AREA, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
ATTR	Name	Number assigned to the attribute, Name, where Name =MAT, TYPE, REAL, ESYS, KB,KE,SECN, NNOD, NELM, or ESIZ. (NNOD=number of nodes, NELM=number of elements, ESIZ=element size.)
ASEL		Select status of area N : -1=unselected, 0=undefined, 1=selected. Alternative get function: ASEL( N ).
NXTH		Next higher area number above N in selected set (or zero if none found).
NXTL		Next lower area number below N in selected set (or zero if none found).
AREA		Area of area N. ( asum or gsum must have been performed sometime previously with at least this area N selected).
LOOP	1,2,…, I	Item2 : LINE, IT2NUM : 1,2,…, p Line number of position p of loop I

*GET Preprocessing Items, Entity = AXIS

Entity = AXIS, ENTNUM = 0 (or blank)

get, Par, AXIS, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT	–	Number of defined sections.
NUM	MAX	Largest section number defined.

*GET Preprocessing Items, Entity = CDSY

Entity = CDSY, ENTNUM = N (coordinate system number)

get, Par, CDSY, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
LOC	X, Y, Z	X, Y, or Z origin location in global Cartesian system.
ANG	XY, YZ, ZX	THXY, THYZ, or THZX rotation angle (in degrees) relative to the global Cartesian coordinate system.
ATTR	Name	Number assigned to Name, where Name =KCS, KTHET, KPHI, PAR1, or PAR2. The value -1.0 is returned for KCS if the coordinate system is undefined.
NUM	MAX	The maximum coordinate system number

*GET Preprocessing Items, Entity = CE

Entity = CE, ENTNUM = N (constraint equation set)

get, Par, CE, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
If N = 0, then
MAX		Maximum constraint equation number
NUM		Number of constraint equations
If N > 0, then
NTERM		Number of terms in this constraint equation
CONST		Constant term for this constraint equation
TERM	number	Item2 = NODE: Gives the node for this position in the constraint equation. Item2 = DOF: Gives the DOF number for this position in the constraint equation. (1-UX, 2-UY, 3-UZ, 4-ROTX, etc.) Item2 = COEF: Gives the coefficient for this position in the constraint equation.

*GET Preprocessing Items, Entity = CMPB

Entity = CMPB, ENTNUM = N (composite beam section identification number)

get, Par, CMPB, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT		Number of defined sections. If Item1 = COUNT, then N is blank.
NUM	MAX	Largest section number defined. If IT1NUM = MAX, then N is blank.
EXIS		Returns a 1 if the section exists and if it is a CMPB section.
NAME		The 8-character section name defined via the sectype command.
One of the following: * CBMX * CBTE * CBMD		Item2 = NTEM (the number of temperatures for cbmx, cbte, or cbmd data).
One of the following: * CBMX * CBTE * CBMD		Item2 = TVAL; IT2NUM = nnn where nnn is the temperature value (< = NTEM).
One of the following: * CBMX * CBTE * CBMD	nnn	Item2 = TEMP; IT2NUM = tval Where nnn is the location in the cbmx, cbte, or cbmd command for the given coefficient number, and tval is the temperature value.

*GET Preprocessing Items, Entity = CP

Entity = CP, ENTNUM = N (coupled node set)

get, Par, CP, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
If N = 0, then
MAX		Maximum coupled set number
NUM		Number of coupled sets
If N > 0, then
DOF		The degree of freedom for this set (1-UX, 2-UY, 3-UZ, 4-ROTX, etc.)
NTERM		Number of nodes in this set.
TERM	number	Item2 = NODE: Gives the node for this position number in the coupled set.

*GET Preprocessing Items, Entity = CSEC

Entity = CSEC, ENTNUM = 0 (or blank)

get, Par, CSEC, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT	–	Number of defined sections.
NUM	MAX	Largest section number defined.

*GET Preprocessing Items, Entity = ELEM

Entity = ELEM, ENTNUM = N (element number)

get, Par, ELEM, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
NODE	1, 2,… 20	Node number at position 1,2,… or 20 of element N. Alternative get function: NELEM( n,npos ), where npos is 1,2,…20.
CENT	X, Y, Z	Centroid X, Y, or Z location (based on shape function) in the active coordinate system. The original locations is used even if large deflections are active. Alternative get functions: CENTRX( N ), CENTRY( N ), and CENTRZ( N ) always retrieve the element centroid in global Cartesian coordinates, and are determined from the selected nodes on the elements.
ADJ	1, 2,… 6	Element number adjacent to face 1,2,…6. Alternative get function: ELADJ( N, face ). Only elements (of the same dimensionality) adjacent to lateral faces are considered.
ATTR	Name	Number assigned to the attribute Name, where Name = MAT, TYPE, REAL, ESYS, PSTAT, LIVE, or SECN. Returns a zero if the element is unselected. If Name = LIVE, returns a 1 if the element is selected and active, and a -1 if it is selected and inactive. Name = SECN returns the section number of the selected beam element.
LENG		Length of line element (straight line between ends).
LPROJ	X, Y, Z	Projected line element length (in the active coordinate system). X is x-projection onto y-z plane, Y is y projection onto z-x plane, and Z is z-projection onto x-y plane.
AREA		Area of area element.
APROJ	X, Y, Z	Projected area of area element area (in the active coordinate system). X is x-projection onto y-z plane, Y is y projection onto z-x plane, and Z is z-projection onto x-y plane.
VOLU		Element volume. Based on unit thickness for 2D plane elements (unless the thickness option is used) and on the full 360 degrees for 2D axisymmetric elements. For general axisymmetric elements SOLID272 and SOLID273, only the area of the element on the master plane is reported before solving, not the volume. After solving, the volume is reported. If results data are in the database, the volume returned is the volume calculated during solution.
ESEL		Select status of element N : -1 = unselected, 0 = undefined, 1 = selected. Alternative get function: ESEL( N ).
NXTH		Next higher element number above N in selected set (or zero if none found). Alternative get function: ELNEXT( N )
NXTL		Next lower element number below N in selected set (or zero if none found).
HGEN		Heat generation on selected element N.
DGEN		Diffusing substance generation on selected node N (returns 0.0 if node is unselected, or if the DOF is inactive).
HCOE	face	Heat coefficient for selected element N on specified face. Returns the value at the first node that forms the face.
TBULK	face	Bulk temperature for selected element N on specified face. Returns the value at the first node that forms the face.
PRES	face	Pressure on selected element, N on specified face. Returns the value at the first node that forms the face.
SHPAR	Test	Element shape test result for selected element N, where Test = ANGD, ASPE (aspect ratio), JACR (Jacobian ratio), MAXA (maximum corner angle), PARA (deviation from parallelism of opposite edges), or WARP (warping factor).
MEMBER	COUNT	Number of reinforcing members (individual reinforcings) in the element N.
EGID	COUNT	Number of non-duplicate global identifiers in the element N.
	MIN, MAX	Lowest or highest global identifier in the element N.

*GET Preprocessing Items, Entity = ETYP

Entity = ETYP, ENTNUM = N (element type number)

get, Par, ETYP, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
ATTR	Name	Number assigned to the attribute Name, where Name =ENAM, KOP1, KOP2,…, KOP9, KO10, KO11, etc.

*GET Preprocessing Items, Entity = GCN

Entity = GCN, ENTNUM = 0 (or blank)

get, Par, GCN, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
MAT	Sect1	Item2 = 0 or blank; IT2NUM = Sect2. Material ID to be used for general contact between Sect1 and Sect2 . Alternative get function: SECTOMAT( Sect1, Sect2 ).
REAL	Sect1	Item2 = 0 or blank; IT2NUM = Sect2. Real constant ID to be used for general contact between Sect1 and Sect2 . Alternative get function: SECTOREAL( Sect1, Sect2 ).
DEF	Sect1	Item2 = 0 or blank; IT2NUM = Sect2. Number indicating the type of contact for the general contact definition between Sect1 and Sect2 : * = 0 - Excluded general contact between Sect1 / Sect2 * = 1 - Asymmetric general contact between Sect1 (contact) / Sect2 (target) * = 2 - Asymmetric general contact between Sect1 (target) / Sect2 (contact) * = 3 - Symmetric general contact between Sect1 / Sect2
Sect1 and Sect2 are section numbers associated with general contact surfaces.

*GET Preprocessing Items, Entity = GENB

Entity = GENB, ENTNUM = N (nonlinear beam general section identification number)

get, Par, GENB, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT	(Blank)	Number of defined sections. If Item1 = COUNT, then N is blank.
NUM	MAX	Largest section number defined. If IT1NUM = MAX, then N is blank.
EXIS	(Blank)	Returns a 1 if the section exists and if it is a GENB section.
SUBTYPE	(Blank)	Section subtype for the section ID specified via the sectype command.
NAME	(Blank)	The 8-character section name defined via the sectype command.
One of the following: * BSAX * BSM1 * BSM2 * BSTQ * BSS1 * BSS2 * BSMD * BSTE	(Blank)	Item2 = NTEM, the number of temperatures for bsax, bsm1, bsm2, bstq, bss1, bss2, bsmd, or bste data.
One of the following: * BSAX * BSM1 * BSM2 * BSTQ * BSS1 * BSS2 * BSMD * BSTE	(Blank)	Item2 = TVAL; IT2NUM = nnn Where nnn is the temperature value (<= NTEM).
One of the following: * BSAX * BSM1 * BSM2 * BSTQ * BSS1 * BSS2 * BSMD * BSTE	nnn	Item2 = TEMP; IT2NUM = tval Where nnn is the location in the bsax, bsm1, bsm2, bstq, bss1, bss2, bsmd, or bste command for the given coefficient number, and tval is the temperature value. Examples for nnn : * nnn = 1 for STRAIN(1) * nnn = 2 for STRESS(1) * nnn = 3 for STRAIN(2) * nnn = 4 for STRESS(2) * nnn = 5 for STRAIN(3) *…
One of the following: * BSAX * BSM1 * BSM2 * BSTQ * BSS1 * BSS2 * BSMD * BSTE	(Blank)	Item2 = TEMP; IT2NUM = tval ; Item3 = NCONST The number of constants at tval.

*GET Preprocessing Items, Entity = GENS

Entity = GENS, ENTNUM = N (preintegrated shell general section identification number)

get, Par, GENS, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT	(Blank)	Number of defined sections. If Item1 = COUNT, then N is blank.
NUM	MAX	Largest section number defined. If IT1NUM = MAX, then N is blank.
EXIS	(Blank)	Returns a 1 if the section exists and if it is a GENS section.
NAME	(Blank)	The 8-character section name defined via the sectype command.
One of the following: * SSPA * SSPB * SSPD * SSPE * SSMT * SSBT * SSPM	(Blank)	Item2 = NTEM, the number of temperatures for sspa, sspb, sspd, sspe, ssmt, ssbt, or sspm data.
One of the following: * SSPA * SSPB * SSPD * SSPE * SSMT * SSBT * SSPM	(Blank)	Item2 = TVAL; IT2NUM = nnn Where nnn is the temperature value (<= NTEM).
One of the following: * SSPA * SSPB * SSPD * SSPE * SSMT * SSBT * SSPM	nnn	Item2 = TEMP; IT2NUM = tval Where nnn is the location in the sspa, sspb, sspd, sspe, ssmt, ssbt, or sspm command for the given coefficient number, and tval is the temperature value.

*GET Preprocessing Items, Entity = KP

Entity = KP, ENTNUM = N (keypoint number)

get, Par, KP, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
LOC	X, Y, Z	X, Y, or Z location in the active coordinate system. Alternative get functions: KX( N ), KY( N ), KZ( N ). Inverse get function: KP( x,y,z ) returns the number of the selected keypoint nearest the x,y,z location (in the active coordinate system, lowest number for coincident keypoints).
ATTR	Name	Number assigned to the attribute Name, where Name = MAT, TYPE, REAL, ESYS, NODE, or ELEM.
KSEL		Select status of keypoint N : -1 = unselected, 0 = undefined, 1 = selected. Alternative get function: KSEL( N ).
NXTH		Next higher keypoint number above N in selected set (or zero if none found). Alternative get function: KPNEXT( N ).
NXTL		Next lower keypoint number below N in selected set (or zero if none found).
DIV		Divisions (element size setting) from kesize command.

*GET Preprocessing Items, Entity = LINE

Entity = LINE, ENTNUM = N (line number)

get, Par, LINE, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
KP	1,2	Keypoint number at position 1 or 2.
ATTR	Name	Number assigned to the attribute, Name, where Name =MAT, TYPE, REAL, ESYS, NNOD, NELM, NDIV, NDNX, SPAC, SPNX, KYND, KYSP, LAY1, or LAY2. (NNOD=number of nodes, returns –1 for meshed line with no internal nodes, NELM=number of elements, NDIV=number of divisions in an existing mesh, NDNX=number of divisions assigned for next mesh, SPAC=spacing ratio in an existing mesh, SPNX=spacing ratio for next mesh, KYND=soft key for NDNX, KYSP=soft key for SPNX, LAY1=LAYER1 setting, LAY2=LAYER2 setting.)
LSEL		Select status of line N : -1=unselected, 0=undefined, 1=selected. Alternative get function: LSEL( N ).
NXTH		Next higher line number above N in the selected set (or zero if none found). Alternative get function: LSNEXT( N )
NXTL		Next lower line number below N in selected set (or zero if none found).
LENG		Length. A get function LX( n,lfrac ) also exists to return the X coordinate location of line N at the length fraction lfrac (0.0 to 1.0). Similar LY and LZ functions exist.

*GET Preprocessing Items, Entity = LINK

Entity = LINK, ENTNUM = 0 (or blank)

get, Par, LINK, NUM, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT		Number of defined sections.
NUM	MAX	Largest section number defined.

*GET Preprocessing Items, Entity = MAT

Entity = MAT, ENTNUM = 0 (or blank)

get, Par, MAT, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT		Number of materials.
NUM	MAX	Largest material number for which at least one property is defined.

*GET Preprocessing Items, Entity = MPLAB

Entity = MPlab, ENTNUM = N ( MPlab = material property label from mp command; N = material number.)

get, Par, MPlab, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
TEMP	val	Material property value at temperature of val . For temperature dependent materials, the program interpolates the property at temperature input for val.

*GET Preprocessing Items, Entity = NODE

Entity = NODE, ENTNUM = N (node number)

get, Par, NODE, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
LOC	X, Y, Z	X, Y, Z location in the active coordinate system. Alternative get functions: NX( N ), NY( N ), NZ( N ). Inverse get function. NODE( x,y,z ) returns the number of the selected node nearest the x,y,z location (in the active coordinate system, lowest number for coincident nodes).
ANG	XY, YZ, ZX	THXY, THYZ, THZX rotation angle.
NSEL		Select status of node N : -1=unselected, 0=undefined, 1=selected. Alternative get function: NSEL( N ).
NXTH		Next higher node number above N in selected set (or zero if none found). Alternative get function: NDNEXT( N ).
NXTL		Next lower node number below N in selected set (or zero if none found).
F	FX, MX,…	Applied force at selected node N in direction IT1NUM (returns 0.0 if no force is defined, if node is unselected, or if the DOF is inactive). If ITEM2 is IMAG, return the imaginary part.
D	UX, ROTX,…	Applied constraint force at selected node N in direction IT1NUM (returns a large number, such as 2e100, if no constraint is specified, if the node is unselected, or if the DOF is inactive). If ITEM2 is IMAG, return the imaginary part.
HGEN		Heat generation on selected node N (returns 0.0 if node is unselected, or if the DOF is inactive).
NTEMP		Temperature on selected node N (returns 0.0 if node is unselected)
CPS	Lab	Couple set number with direction Lab = any active DOF, which contains the node N.
DGEN		Diffusing substance generation on selected node N (returns 0.0 if node is unselected, or if the DOF is inactive).

*GET Preprocessing Items, Entity = OCEAN

Entity = OCEAN, ENTNUM = Type (where Type is a valid label on the DataType field of the octype command)

get, Par, OCEAN, Type, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
NAME		Name defined for a given Type
DATA	1	Depth when Type = BASI
	2	Material ID when Type = BASI
	8	KFLOOD when Type = BASI
	9	Cay when Type = BASI
	10	Cb when Type = BASI
	11	Zmsl when Type = BASI
	13	Caz when Type = BASI
	14	Ktable when Type = BASI
	1	KWAVE when Type = WAVE
	2	THETA when Type = WAVE
	3	WAVELOC when Type = WAVE
	4	KCRC when Type = WAVE
	5	KMF when Type = WAVE
	6	PRKEY when Type = WAVE
PROP	NROW	Number of rows defined by octable command
TABL	i	Data in table defined by octable command i = row number; Item2 = column number

This command contains some tables and extra information which can be inspected in the original documentation pointed above.

*GET Preprocessing Items, Entity = OCZONE

Entity = OCZONE, ENTNUM = Name (where Name is a valid label on the ZoneName field of the oczone command)

get, Par, OCZONE, Name, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
DATA	8	KFLOOD for a given ENTNUM = Name
	9	Cay for a given ENTNUM = Name
	10	Cb for a given ENTNUM = Name
	13	Caz for a given ENTNUM = Name
PROP	NROW	Number of rows defined by octable command
TABL	i	Data in table defined by octable command i = row number; Item2 = column number
TYPE		Ocean zone type (returns 1, 2 or 3 for ZLOC-, COMP-, or PIP-type zones, respectively)
COMP		Component name when the given ocean zone type is COMP, or internal component name when the given ocean zone type is PIP
COMP2		External component name when the type of given ocean zone is PIP

This command contains some tables and extra information which can be inspected in the original documentation pointed above.

This command contains some tables and extra information which can be inspected in the original documentation pointed above.

*GET Preprocessing Items, Entity = PIPE

Entity = PIPE, ENTNUM = 0 (or blank)

get, Par, PIPE, NUM, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT		Number of defined sections
NUM	MAX	Largest section number defined

*GET Preprocessing Items, Entity = PART

Entity = PART, ENTNUM = N (PART number)

get, Par, PART, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
TYPE		Element type number assigned to PART N.
MAT		Material number assigned to PART N.
REAL		Real constant number assigned to PART N.

*GET Preprocessing Items, Entity = RCON

Entity = rcon, ENTNUM = N (real constant set number)

get, Par, RCON, N, Item1, IT1NUM, Item2, IT2NUM
CONST	1, 2,…, m	Value of real constant number m in set N.
get	[*GET ,Par, RCON,0, Item1, IT1NUM, Item2, IT2NUM]
NUM	MAX	The maximum real constant set number defined

*GET Preprocessing Items, Entity = REIN

Entity = REIN, ENTNUM = N (reinforcing section identification number)

get, Par, REIN, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
TYPE		Section type, for ID – sectype command (always REIN for reinforcing sections).
SUBTYPE		Section subtype for ID – sectype command.
NAME		Name defined for a given ID number.
NREIN		Number of reinforcing fibers. For reinforcing sections generated ( ereinf ) via the standard method, the number of fibers defined via secdata. For reinforcing sections generated ( ereinf ) via the mesh-independent method, the total number of fibers in the section.
TABL	ReinfNum,I	Reinforcing fiber data, as defined via secdata. This item is not allowed for reinforcing sections generated ( ereinf ) via the mesh-independent method.

*GET Preprocessing Items, Entity = SCTN

Entity = SCTN, ENTNUM = N (pretension section ID number)

get, Par, SCTN, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
1		Section ID number.
2		Section type (always 5 for pretension section).
3		Pretension node number.
4	Coordinate system number.	Section normal NX.
5	Coordinate system number.	Section normal NY.
6	Coordinate system number.	Section normal NZ.
7 or 8		Eight character section name.
9		Initial action key. Returns 0 or 1 for lock, 2 for “free-to-slide,” or 3 for tiny.
10		Force displacement key. Returns 0 or 1 for force, or 2 for displacement.
11		First preload value.
12		Load step in which first preload value is to be applied.
13		Load step in which first preload value is to be locked.
14…		14 through 17 is a repeat of 10 through 13, but for the second preload value; 18 through 21 is for the third preload value; and so forth.

*GET Preprocessing Items, Entity = SECP

Entity = SECP, ENTNUM = 0 (or blank)

get, Par, SECP, NUM, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
COUNT		Number of defined sections
NUM	MAX	Largest section number defined

*GET Preprocessing Items, Entity = SHEL

Entity = SHEL, ENTNUM = N (shell section identification number)

get, Par, SHEL, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
TYPE		Section type, for id – sectype command. (always SHEL for shell sections)
NAME		Name defined for a given id number.
PROP	TTHK	Total thickness.
	NLAY	Number of layers.
	NSP	Number of section integration points.
	POS	Node position (as defined by secoffset ).
		0 = User Defined.
		1 = Middle.
		2 = Top.
		3 = Bottom.
	OFFZ	User-defined section offset (POS = 0).
	TS11	Transverse shear stiffness factors.
	TS22	Transverse shear stiffness factors.
	TS12	Transverse shear stiffness factors.
	HORC	Homogeneous or complete section flag.
		0 = Homogeneous.
		1 = Composite.
	FUNC	Tabular function name for total thickness.
	UT11	User transverse shear stiffness 11.
	UT22	User transverse shear stiffness 22.
	UT12	User transverse shear stiffness 12.
	AMAS	Added mass.
	MSCF	Hourglass control membrane scale factor.
	BSCF	Hourglass control bending scale factor.
	DSTF	Drill stiffness scale factor.
	LDEN	Laminate density.
	FKCN	KCN field value from the secfunction command, in which the array or table is interpreted.
	ABD	Section membrane and bending stiffness matrix. Valid ITEM2 = 1,6 and IT2NUM = 1,6.
	E	Section transverse shear stiffness matrix. Valid ITEM2 = 1,2 and IT2NUM = 1,2.
LAYD	LayerNumber,THIC	Layer thickness.
	LayerNumber,MAT	Layer material.
	LayerNumber,ANGL	Layer orientation angle.
	LayerNumber,NINT	Number of layer integration points.

*GET Preprocessing Items, Entity = TBFT

Entity = TBFT, ENTNUM = blank

get, Par, TBFT, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
nmat		Number of defined material models.
matnum	index	Material number in array (index varies for 1 to num materials).
Entity = TBFT, ENTNUM = matid (For getting names of constitutive function, matid = the material ID number)
get	[*GET ,Par, TBFT,matid,nfun,IT1NUM,Item2,IT2NUM]
Item1	IT1NUM	Description
nfun		Number of constitutive functions for this material.
Entity = TBFT, ENTNUM = matid (To query constitutive function data, matid = the material ID number)
get	[*GET ,Par, TBFT,matid,func,fname,Item2,IT2NUM]
Item1	IT1NUM	Description
func	index	If Item2 = fname, the name of the constitutive function is returned.
func	function name	If Item2 = ncon, the number of constants is returned for the function specified in IT1NUM by the constitutive function name.
“	“	If Item2 = cons, set Item2num to index to return the value of the constant.
“	“	If Item2 = fixe, set Item2num to index to return the fix flag status.
“	“	If Item2 = RESI, returns the residual error while fitting the data.
“	“	If Item2 = type, returns the category of the constitutive model (moon, poly, etc.)
“	“	If Item2 = sord, returns the shear order of the prony visco model.
“	“	If Item2 = bord, returns the bulk order of the prony visco model.
“	“	If Item2 = shif, returns the shift function name of the prony visco model.
Entity = TBFT, ENTNUM = matid (For getting names of experimental data, matid = the material ID number)
get	[*GET ,Par, TBFT,matid,nexp,IT1NUM,Item2,IT2NUM]
Item1	IT1NUM	Description
nexp		Number of experiments for this material.
Entity = TBFT, ENTNUM = matid (To query experimental data, matid = the material ID number))
get	[*GET ,Par, TBFT,matid,func,fname,Item2,IT2NUM]
Item1	IT1NUM	Description
“	expindex	If Item2 = type, returns experiments type string.
“	“	If Item2 = numrow, returns number of rows in the data.
“	“	If Item2 = numcol, returns the number of cols in a row (set Intem2num = Row index)
“	“	If Item2 = data, returns the value of the data in row, col of exp expindex (set item2Num = row index and item3 = column index. All indices vary from 1 to the maximum value.
“	“	If Item2 = natt, returns the number of attributes.
“	“	If Item2 = attname, returns the attribute name (set Item2Num = Attr index).
“	“	If Item2 = attvald, returns double value of attribute (set Item2Num = Attr index).
“	“	If Item2 = attvali, returns integer valud of attribute (set Item2Num = Attr index).
“	“	If Item2 = attvals, returns the string value of the attribute (set Item2Num = Attr index).

*GET Preprocessing Items, Entity = TBLAB

Entity = TBLAB, ENTNUM = N..( TBlab = data table label from the tb command; N = material number.)

get, Par, TBlab, N, Item1, IT1NUM, Item2, IT2NUM, TBOPT
Item1	IT1NUM	Description
TEMP	T	Item2 : CONST IT2NUM : Num Value of constant number Num in the data table at temperature T. For constants, input an X,Y point; the constant numbers are consecutive with the X constants being the odd numbers, beginning with one.
To get all necessary output for materials defined via the tb command, you must specify the final argument TBOPT as indicated in the syntax description above.

*GET Preprocessing Items, Entity = VOLU

Entity = VOLU, ENTNUM = N (volume number)

get, Par, VOLU, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
ATTR	Name	Number assigned to the attribute Name, where Name =MAT, TYPE, REAL, ESYS, NNOD, or NELM. (NNOD=number of nodes, NELM=number of elements.)
VSEL		Select status of volume N : -1=unselected, 0=undefined, 1=selected. Alternative get function: VSEL( N ).
NXTH		Next higher volume number above N in selected set (or zero if none found). Alternative get function: VLNEXT( N ).
NXTL		Next lower volume number below N in selected set (or zero if none found).
VOLU		Volume of volume N. ( vsum or gsum must have been performed sometime previously with at least this volume N selected).
SHELL	1, 2,…, m	Item2 : AREA IT2NUM : 1,2,…, p Line number of position p of shell m

Solution Items

*GET Solution Entity Items

• *GET Solution Items, Entity = ACTIVE

• *GET Solution Items, Entity = ELEM

• *GET Solution Items, Entity = MODE

• *GET Solution Items, Entity = DDAM

*GET Solution Items, Entity = ACTIVE

Entity = ACTIVE, ENTNUM = 0 (or blank)

get, Par, ACTIVE, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
ANTY		Current analysis type.
SOLU	DTIME	Time step size.
	NCMLS	Cumulative number of load steps.
	NCMSS	Number of substeps. NOTE: Used only for static and transient analyses.
	EQIT	Number of equilibrium iterations.
	NCMIT	Cumulative number of iterations.
	CNVG	Convergence indicator: 0=not converged, 1=converged.
	MXDVL	Maximum degree of freedom value.
	RESFRQ	Response frequency for 2nd order systems.
	RESEIG	Response eigenvalue for 1st order systems.
	DSPRM	Descent parameter.
	FOCV	Force convergence value.
	MOCV	Moment convergence value.
	HFCV	Heat flow convergence value.
	MFCV	Magnetic flux convergence value.
	CSCV	Current segment convergence value.
	CUCV	Current convergence value.
	FFCV	Fluid flow convergence value.
	DICV	Displacement convergence value.
	ROCV	Rotation convergence value.
	TECV	Temperature convergence value.
	VMCV	Vector magnetic potential convergence value.
	SMCV	Scalar magnetic potential convergence value.
	VOCV	Voltage convergence value.
	PRCV	Pressure convergence value.
	VECV	Velocity convergence value.
	CRPRAT	Maximum creep ratio.
	PSINC	Maximum plastic strain increment.
	CGITER	Number of iterations in the PCG and symmetric JCG (non-complex version) solvers.

*GET Solution Items, Entity = ELEM

Entity = ELEM, ENTNUM = 0 (or blank)

get, Par, ELEM, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
MTOT	X, Y, Z	Total mass components.
MC	X, Y, Z	Center of mass components.
IOR	X, Y, Z, XY, YZ, ZX	Moment of inertia about origin.
IMC	X, Y, Z, XY, YZ, ZX	Moment of inertia about the center of mass.
IPRIN	X, Y, Z	Principal moments of inertia.
IANG	XY, YZ, ZX	Angles of the moments of inertia principal axes.
FMC	X, Y, Z	Force components at mass centroid ( 1).
MMOR	X, Y, Z	Moment components at origin ( 1).
MMMC	X, Y, Z	Moment components at mass centroid ( 1).

Items ( 1) are available only after inertia relief solution ( irlf,1) or pre-calculation of masses ( irlf,-1).

Item values are consistent with the mass summary printed in the output file. They are based on

unscaled mass properties (see mascale command).

*GET Solution Items, Entity = MODE

Entity = MODE, ENTNUM = N (mode number)

get, Par, MODE, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
FREQ		Frequency of mode N. Returned values are valid for modal analyses which calculate real eigensolutions.
STAB		Stability value of mode N. Returned values are valid for modal analyses which calculate complex eigensolutions. The stability value is the real part of the complex eigenvalue. It contains information on the mode damping in a damped modal analysis.
DFRQ		Damped frequency of mode N. Returned values are valid for modal analyses which calculate complex eigensolutions. The damped frequency is the imaginary part of the complex eigenvalue.
PFACT		Participation factor of mode N. * If retrieved after a modal analysis, the real part of the participation factor is returned unless IT1NUM = IMAG. The direction is specified using Item2 = DIREC and IT2NUM = X, Y, Z, ROTX, ROTY, or ROTZ * If retrieved after a spectrum analysis, the spectrum number M is specified using Item2 = SPECT and IT2NUM = M. For a PSD analysis with spatial correlation or wave excitation, the retrieved participation factors will correspond to the first degree of freedom that is excited.
EFFM		Effective mass of mode N. Returned values are valid only after a modal analysis with effective mass calculation has been solved. The direction is specified using Item2 = DIREC and IT2NUM = X, Y, Z, ROTX, ROTY, or ROTZ.
GENM		Generalized mass (also called modal mass) of mode N. Returned values are valid only after a modal analysis with generalized mass calculation has been solved.
MCOEF		Mode coefficient of mode N. Returned values are valid only after a spectrum analysis has been solved. The spectrum number M is specified using Item2 = SPECT and IT2NUM = M. In a SPRS analysis, the values returned are based on the curve with the lowest damping. After a PSD analysis, the diagonal of the dynamic modal covariance matrix is retrieved for the displacement solution.
DAMP		Damping ratio of mode N. If retrieved after a modal analysis that creates complex solutions (DAMP, QRDAMP, or UNSYM eigensolvers) returned value is calculated from the complex frequencies. If retrieved after a spectrum analysis, returned value is the effective damping ratio. Not a function of direction. Also retrievable following a harmonic analysis or transient analysis with mode-superposition.

For all items except PFACT and MCOEF (as noted above), only the first 10000 values corresponding to significant modes will be returned.

The MODE file must be available to retrieve items PFACT and MCOEF with specified Item2. If Item2 is not specified, the last calculated value will be returned.

All values retrieved correspond to the first load step values. For a Campbell diagram analysis (multistep modal), get with Entity = CAMP must be used.

*GET Solution Items, Entity = DDAM

Entity = DDAM, ENTNUM = N (mode number)

get, Par,DDAM, N, Item1, IT1NUM
Item1	IT1NUM	Description
DSHOCK		Shock design value of mode N.

If multiple DDAM analyses are performed, the last calculated value will be returned.

Postprocessing Items

*GET Postprocessing Entity Items

• *GET Postprocessing Items, Entity = ACTIVE

• *GET Postprocessing Items, Entity = ACUS

• *GET Postprocessing Items, Entity = CAMP

• *GET Postprocessing Items, Entity = CINT

• *GET Postprocessing Items, Entity = CYCCALC

• *GET Postprocessing Items, Entity = ELEM

• *GET Postprocessing Items, Entity = ETAB

• *GET Postprocessing Items, Entity = FSUM

• *GET Postprocessing Items, Entity = GSRESULT

• *GET Postprocessing Items, Entity = MEMBER

• *GET Postprocessing Items, Entity = NODE

• *GET Postprocessing Items, Entity = PATH

• *GET Postprocessing Items, Entity = PLNSOL

• *GET Postprocessing Items, Entity = PRENERGY

• *GET Postprocessing Items, Entity = PRERR

• *GET Postprocessing Items, Entity = RAD

• *GET Postprocessing Items, Entity = RSTMAC

• *GET Postprocessing Items, Entity = SECR

• *GET Postprocessing Items, Entity = SECTION

• *GET Postprocessing Items, Entity = SORT

• *GET Postprocessing Items, Entity = SSUM

• *GET Postprocessing Items, Entity = VARI

• *GET Postprocessing Items, Entity = XFEM

*GET Postprocessing Items, Entity = ACTIVE

Entity = ACTIVE, ENTNUM = 0 (or blank)

get, Par, ACTIVE, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
SET	LSTP	Current load step number.
	SBST	Current substep number.
	TIME	Time associated with current results in the database.
	FREQ	Frequency (for ANTYPE=MODAL, HARMIC, SPECTR; load factor for ANTYPE=BUCKLE).
	NSET	If Item2 is blank, number of data sets on result file. * If Item2 = FIRST, IT2NUM = Loadstep, get set number of first substep of loadstep * If Item2 = LAST, IT2NUM = Loadstep, get set number of last substep of loadstep
RSYS		Active results coordinate system.

*GET Postprocessing Items, Entity = ACUS

Entity = ACUS, ENTNUM = 0 (or blank)

get, Par, ACUS, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
PWL		Radiated sound power level
PRES		Far-field pressure at a given point
PHASE		Far-field pressure phase at a given point
SPL		Far-field sound pressure level at a given point
SPLA		Far-field a-weighted sound pressure level at a given point
DG		Far-field directivity at a given point
PS		Far-field scattered pressure at a given point
TS		Far-field target strength at a given point
DFIN		Diffuse sound field incident power
SIMP		Magnitude of specific acoustic impedance on the selected surface
AIMP		Magnitude of acoustic impedance on the selected surface
MIMP		Magnitude of mechanical impedance on the selected surface
APRES		Magnitude of average pressure on the selected surface
FORC		Magnitude of average force on the selected surface
POWER		Acoustic power through the selected surface
BSPL		SPL over frequency band
BSPA		A-weighted SPL over frequency band
PWRF		Reference sound power
TL		Transmission loss
RL		Return loss
Item1 = PWL, PRES, SPL, SPLA, PHASE, DG, PS, and TS are available after issuing the prfar or plfar command. The maximum values are obtained from the current command. Item1 = SIMP, AIMP, MIMP, APRES, FORC, POWER, TL, and RL are available after issuing the corresponding pras command at the current frequency. The values are obtained at the current frequency, or at the last frequency for multiple load step and substep cases. Item1 = DFIN is available after the diffuse sound field solution.

*GET Postprocessing Items, Entity = CAMP

Available after plcamp or prcamp command is issued. Entity = CAMP, ENTNUM = N (mode number)

get, Par, CAMP, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
NBMO		Number of modes in the Campbell diagram ( ENTNUM not required). This value is the maximum value for N.
NBST		Number of steps in the Campbell diagram: modal load steps with rotational velocity ( ENTNUM not required). This value is the maximum value for M (see Item1 = FREQ).
WHRL	M	Whirl of mode N at step M : -1 is backward whirl, 1 is forward whirl, and 0 is undetermined. For default IT1NUM, it corresponds to the whirl at the maximum rotational velocity.
VCRI		Critical speed for mode N. This value is available if an excitation is defined via the plcamp or prcamp command’s SLOPE argument. (The unit of speed depends upon the UNIT value specified in those commands.) N does not correspond to the mode number if FREQB ( prcamp or plcamp command) is used. Instead, it represents the Nth mode number listed in the output of prcamp or plcamp.
FREQ	M	Natural frequency of mode (Hz) N at step M. It represents the complex part of the eigenvalue.
STAB	M	Stability value (Hz) of mode N at step M. It represents the real part of the eigenvalue.
UKEY	M	Instability key for mode N at step M : 0 is stable and 1 is unstable. For default IT1NUM, it corresponds to the stability over the whole rotational velocity range.
VSTA		Stability limit for mode N. This value is available when SLOPE is zero on the plcamp or prcamp command. (The unit of speed depends upon the UNIT value specified in those commands.) N does not correspond to the mode number if FREQB ( prcamp or plcamp command) is used. Instead, it represents the Nth mode number listed in the output of prcamp or plcamp.

If the sorting is activated (Option= ON on the prcamp and plcamp commands), all the parameters retrieved are in the sorted order.

*GET Postprocessing Items, Entity = CINT

Entity = CINT, ENTNUM = CrackId (required Crack ID number)

get, Par, CINT, CrackId, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
CTIP	ctnum	IT1NUM = Crack tip node number (required) Item2 = CONTOUR IT2NUM = Contour number (default 1) Returns JINT value if crack ID is JINT type; otherwise, returns 0. Item1 defaults to CTIP, Item2 defaults to CONTOUR.
Entity= CINT, ENTNUM = CrackID (required Crack ID number)
*GET , Par, CINT, CrackId, Item1, IT1NUM, Item2, IT2NUM, Item3, IT3NUM, Item4, IT4NUM
Item1	IT1NUM	Description
CTIP	ctnum	IT1NUM = Crack tip node number (required) Item2 = CONTOUR IT2NUM = Contour number (default 1) Item3 = DTYPE IT3NUM = Data type (JINT, IIN1, IIN2, IIN3, K1, K2, K3, G1, G2, G3, GT, MFTX, MFTY, MFTZ, TSTRESS, CEXT, STTMAX, PSMAX, CSTAR, DLTA, DLTN, DLTK, R, UFAC, CRDX, CRDY, CRDZ, and APOS) FOR IT3NUM = STTMAX or PSMAX: * Item4 = AINDEX (angle index) * IT4NUM = Index value (1 to N+1; N = Maximum number of intervals for the sweep ( cint,RSWEEP). Returns specified data type value. FOR IT3NUM = DLTA, DLTN, DLTK, R, UFAC, CRDX, CRDY, CRDZ, APOS: * Set IT2NUM = 1 Returns specified data type value. Item1 defaults to CTIP, Item2 defaults to CONTOUR, Item3 defaults to DTYPE. DLTK in a 3D XFEM-based fatigue crack-growth analysis is evaluated based on the smoothed SIFS values. The actual DLTK value can be easily calculated by issuing get for SIFS values and the stress (load) ratio.
Entity= CINT, ENTNUM = CrackID (required Crack ID number)
*GET , Par, CINT, CrackId, Item1, IT1NUM, Item2, IT2NUM ,
Item1	IT1NUM	Description
NNOD		Maximum number of nodes along the crack front.
Entity= CINT, ENTNUM = CrackID (required Crack ID number)
*GET , Par, CINT, CrackId, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
NODE	ipos	IT1NUM = Position along the crack front (from 1 to NNOD). Default = 1. Returns node number at the given position along the crack front. (For XFEM, an internal node number is returned.)

*GET Postprocessing Items, Entity = CYCCALC

Entity = CYCCALC, ENTNUM = cycspec specification number Generate date for cyclic results using cyccalc before retrieving those items.

get, Par,CYCCALC, spec, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Item2	IT2NUM	Description
FREQ	frequency point	SECTOR	sector	cycspec result at the IT1NUM frequency and IT2NUM sector
		SECMAX		cycspec maximum result at the IT1NUM frequency
		SECNUM		cycspec sector with the maximum result at the IT1NUM frequency
		SECNODE		cycspec node in the sector with the maximum result at the IT1NUM frequency
The frequency point refers to the harmonic solution data set number (NSET on the Set displays command)

*GET Postprocessing Items, Entity = ELEM

Entity = elem, ENTNUM = N (element number)

get, Par, ELEM, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
SERR Some element- and material-type limitations apply. For more information, see the documentation for the prerr command.		Structural error energy.
SDSG		Absolute value of the maximum variation of any nodal stress component.
TERR		Thermal error energy.
TDSG		Absolute value of the maximum variation of any nodal thermal gradient component.
SENE		“Stiffness” energy or thermal heat dissipation. Same as TENE.
TENE		Thermal heat dissipation or “stiffness” energy. Same as SENE.
KENE		Kinetic energy.
ASENE		Amplitude “stiffness” energy.
PSENE		Peak “stiffness” energy.
AKENE		Amplitude kinetic energy.
PKENE		Peak kinetic energy.
DENE		Damping energy.
WEXT WEXT is calculated for element-based loading only (and not for nodal-force loading). WEXT is stored on elements to which loading has been applied; if surface elements are added on top of other elements, for example, and pressure loading is applied to the surface elements, WEXT is available for the surface elements only.		Work due to external load.
JHEAT		Element Joule heat generation (coupled-field calculation).
JS	X, Y, Z	Source current density (coupled-field calculation) in the global Cartesian coordinate system.
HS	X, Y, Z	Average element magnetic field intensity from current sources.
VOLU		Element volume, as calculated during solution.
ETAB	Lab	Value of element table item Lab for element N (see etable command).
EFOR	Nnum	Element force at node Nnum. The force label is specified using Item2 = FX, FY, FZ, MX, MY, MZ, or HEAT. In a dynamics analysis, the element forces returned are based on the type of force requested. It is specified using the force command for all dynamics analyses, except for spectrum analyses where ForceType is used on the combination commands ( srss, psdcom, etc.).
SMISC	Snum	Value of element summable miscellaneous data at sequence number Snum (as used on etable command).
NMISC	Snum	Value of element non-summable miscellaneous data at sequence number Snum (as used on etable command).
FSOU		Element fluid flow source loading (poromechanics).

*GET Postprocessing Items, Entity = ETAB

Entity = ETAB, ENTNUM = N (column number)

get, Par, ETAB, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
LAB		Label for column N of the element table ( etable ). Returns a character parameter.
ELEM	E	Value in etable column N for element number E.

*GET Postprocessing Items, Entity = FSUM

Entity = fsum, ENTNUM = 0 (or blank)

get, Par, FSUM, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
ITEM	Lab	Value of item Lab from last fsum command. Valid labels are FX, FY, FZ, MX, MY, MZ, FLOW, HEAT, FLUX, etc.

*GET Postprocessing Items, Entity = GSRESULT

Entity = GSRESULT, ENTNUM = 0 (or blank) for generalized plane strain results in fiber direction

get, Par, GSRESULT, 0, Item1, IT1NUM
Item1	IT1NUM	Description
LFIBER		Fiber length change at ending point.
ROT	X,Y	Rotation angle of end plane about X or Y axis.
F		Reaction force at ending point.
M	X,Y	Reaction moment on ending plane.

*GET Postprocessing Items, Entity = MEMBER

Entity = MEMBER, ENTNUM = N (GroupID)

get, Par,MEMBER, N, Item1, IT1NUM
Item1	IT1NUM	Description
TEMP	MIN, MAX	Minimum or maximum temperature of members (individual reinforcings) with GroupID = N in the selected set of reinforcing elements.

*GET Postprocessing Items, Entity = NODE

Entity = NODE, ENTNUM = N (node number) for nodal degree-of-freedom results:

get, Par, NODE, N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
U	X, Y, Z, SUM	X, Y, or Z structural displacement or vector sum. Alternative get functions: UX( N ), UY( N ), UZ( N ).
ROT	X, Y, Z, SUM	X, Y, or Z structural rotation or vector sum. Alternative get functions: ROTX( N ), ROTY( N ), ROTZ( N ).
TEMP		Temperature. For SHELL131 and SHELL132 elements with KEYOPT(3) = 0 or 1, use TBOT, TE2, TE3,…, TTOP instead of TEMP. Alternative get functions: TEMP( N ), TBOT( N ), TE2( N ), etc.
PRES		Pressure. Alternative get function: PRES( N ).
GFV1, GFV2, GFV3		Nonlocal field values 1, 2, and 3.
VOLT		Electric potential. Alternative get function: VOLT( N ).
CONC		Concentration.
MAG		Magnetic scalar potential. Alternative get function: MAG( N ).
V	X, Y, Z, SUM	X, Y, or Z fluid velocity or vector sum in a fluid analysis. X, Y, or Z nodal velocity or vector sum in a structural transient analysis (analysis with antype,TRANS). Alternative get functions: VX( N ), VY( N ), VZ( N ).
A	X, Y, Z, SUM	X, Y, or Z magnetic vector potential or vector sum in an electromagnetic analysis. X, Y, or Z nodal acceleration or vector sum in a structural transient analysis (analysis with antype,TRANS). Alternative get functions: AX( N ), AY( N ), AZ( N ).
CURR		Current.
EMF		Electromotive force drop.
RF	FX, FY, FZ, MX, MY, MZ, CSGZ, BMOM, RATE, DVOL, FLOW, HEAT, AMPS or CHRG, FLUX, CURT, VLTG	Nodal reaction forces in the nodal coordinate system. The reaction forces returned are the total forces: static, plus damping, plus inertial, as appropriate based on analysis type (see prrsol command). The first exception is modal analyses and mode-superposition transient analyses where static forces are returned. The second exception is spectrum analyses where the prrfor logic is used internally. In this case, the reaction forces are based on the type of force requested (using ForceType with combination commands, such as srss, psdcom, etc.).
ORBT	A, B, PSI, PHI, YMAX, ZMAX, Whirl	Whirl orbit characteristics: * A is the semi-major axis. * B is the semi-minor axis. * PSI is the angle between the local axis y and the major axis Y. * PHI is the angle between initial position (t = 0) and major axis. * YMAX is the maximum displacement along local y axis. * ZMAX is the maximum displacement along local z axis. * Whirl is the direction of an orbital motion (-1 is backward whirl, 1 is forward whirl, and 0 is undetermined). Angles PSI and PHI are in degrees and within the range of -180 through +180. Orbits are available only after issuing a prorb command.
Use this command carefully when N represents an internal node, as the nodal degrees of freedom may have different physical meanings.

*GET Postprocessing Items, Entity = PATH

Entity = PATH, ENTNUM = 0 (or blank)

get, Par, PATH, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
MAX	Lab	Maximum value of path item Lab from last path operation. Valid labels are the user-defined labels on the pdef or pcalc command.
MAXPATH		Returns the maximum path number defined.
MIN	Lab	Minimum value of path item Lab from last path operation. Valid labels are the user-defined labels on the pdef or pcalc command.
LAST	Lab	Last value of path item Lab from last path operation. Valid labels are the user-defined labels on the pdef or pcalc command.
NODE		Value providing the number of nodes defining the path referenced in the last path operation.
ITEM	Lab	Item2 = PATHPT, IT2NUM = n The value of Lab at the n th data point from the last path operation.
POINT	n	Item2 = X,Y,Z, or CSYS. Returns information about the nth point on the current path.
NVAL		The number of path data points (the length of the data table) from the last path operation.
SET	n	Item2 = NAME. Returns the name of the n th data set on the current path.
NUMPATH		Returns the number of paths defined.

*GET Postprocessing Items, Entity = PLNSOL

Entity = plnsol You must issue the show command before commands that produce a graphical output when running in batch mode to produce/export graphic files. For more details, see External Graphics Options, ENTNUM = 0 (or blank)

get, Par, PLNSOL, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
MAX		Maximum value of item in last contour display ( plnsol, plesol ).
MIN		Minimum value of item in last contour display ( plnsol, plesol ).
BMAX		Maximum bound value of item in last contour display ( plnsol, plesol ).
BMIN		Minimum bound value of item in last contour display ( plnsol, plesol ).

*GET Postprocessing Items, Entity = PRENERGY

Available after the prenergy command is issued. Entity = PRENERGY, ENTNUM = N (component number)

get, Par, PRENERGY, N, Item1, IT1NUM
Item1	IT1NUM	Description
NCMP		Number of components ( ENTNUM not required). This value is the maximum value for N.
NENE		Number of energy types ( ENTNUM not required). This value is the maximum value for M.
TOTE	M	Total energy of type M of the model ( ENTNUM not required). Energy value is non-zero when Cname1 is blank on prior prenergy command.
ENG	M	Energy of type M of component N. Energy value is non-zero when Cname1 is specified on prior prenergy command.
PENG	M	Percentage of energy of type M of component N. Percentage of energy value is non-zero when Cname1 is specified on prior prenergy command.
Ordering of N and M corresponds to prenergy output.

*GET Postprocessing Items, Entity = PRERR

Entity = PRERR, ENTNUM = 0 (or blank)

get, Par, PRERR, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
SEPC[ starget_prerr_limits ]		Structural percent error in energy norm ( prerr ).
TEPC[ starget_prerr_limits ]		Thermal percent error in energy norm ( prerr ).
SERSM[ starget_prerr_limits ]		Structural error energy summation ( prerr ).
TERSM[ starget_prerr_limits ]		Thermal error energy summation ( prerr ).
SENSM[ starget_prerr_limits ]		Structural energy summation ( prerr ).
TENSM[ starget_prerr_limits ]		Thermal energy summation ( prerr ).

Some element- and material-type limitations apply. For more information, see the documentation for the prerr command.

*GET Postprocessing Items, Entity = RAD

Entity = RAD, ENTNUM = 0 (or blank)

get, Par, RAD, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
VFAVG		Value of the average view factor computed from the previous VFQUERY command.

*GET Postprocessing Items, Entity = RSTMAC

Available after rstmac command is issued. Entity = rstmac, ENTNUM = N (solution number on File1 )

get, Par, RSTMAC, 0 or N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
NS1		Total number of solutions (modes for example) read on File1. See Sbstep1 on the rstmac command. This value is the maximum value for N.
NS2		Total number of solutions (modes for example) read on File2. See Sbstep2 on the rstmac command. This value is the maximum value for M
MAC	M	Modal assurance criterion value (MAC) between the solution N read on File1 and the solution M read on File2. N and M do not correspond to the substep (or mode) numbers if NS1 and NS2 are different from the total number of substeps (or modes).
MACCYC	M	Modal assurance criterion value (MAC) from compressed table for cyclic between the solution N read on File1 and the solution M read on File2. N and M do not correspond to the substep (or mode) numbers if NS1 and NS2 are different from the total number of substeps (or modes).

*GET Postprocessing Items, Entity = SECR

Entity = SECR, ENTNUM = n (element number) For beam and pipe (including elbow) section results, return values for all elements if the element number ( n ) is blank or ALL.

get, Par, SECR, n, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description	Item2	IT2NUM
S	X, Y, Z, XY, YZ, XZ	Component total stress	MAX - Returns maximum MIN - Returns minimum MAXY - Returns section Y location of maximum MAXZ - Returns section Z location of maximum MINY - Returns section Y location of minimum MINZ - Returns section Z location of minimum IVAL - Returns value at node or integration point at element I node JVAL - Returns value at node or integration point at element J node KVAL - Returns value at node or integration point at element K node ( ELBOW290 ) — For IVAL, JVAL, and KVAL: The ALL (or blank) option for the element number is not valid. You must specify an element ( n ).	These values are applicable only when Item2 = IVAL, JVAL, or KVAL: When KEYOPT(15) = 0, this value is the section node number (which can be visualized via secplot,,2). When KEYOPT(15) = 1 (or when using elbow elements), this value is the integration point number.
	1, 2, 3	Principal stress value
	INT	Stress intensity value
	EQV	Equivalent stress value
EPTO	X, Y, Z, XY, YZ, XZ	Component total strain
	1, 2, 3	Principal total strain value
	INT	Total strain intensity value
	EQV	Equivalent total strain value
EPEL	X, Y, Z, XY, YZ, XZ	Component elastic strain
	1, 2, 3	Principal elastic strain value
	INT	Elastic strain intensity value
	EQV	Equivalent elastic strain value
EPTH	X, Y, Z, XY, YZ, XZ	Component thermal strain
	1, 2, 3	Principal thermal strain value
	INT	Thermal strain intensity value
	EQV	Equivalent thermal strain value
EPPL	X, Y, Z, XY, YZ, XZ	Component plastic strain
	1, 2, 3	Principal plastic strain value
	INT	Plastic strain intensity value
	EQV	Equivalent plastic strain value
EPCR	X, Y, Z, XY, YZ, XZ	Component creep strain
	1, 2, 3	Principal component creep strain value
	INT	Component creep strain intensity value
	EQV	Equivalent component creep strain value
EPTT	X, Y, Z, XY, YZ, XZ	Component total mechanical and thermal and swelling strain
	1, 2, 3	Principal total mechanical and thermal and swelling strain value
	INT	Total mechanical and thermal and swelling strain intensity value
	EQV	Equivalent total mechanical and thermal and swelling strain value
EPDI	X, Y, Z, XY, YZ, XZ	Component diffusion strain
	1, 2, 3	Principal diffusion strain value
	INT	Diffusion strain intensity value
	EQV	Equivalent diffusion strain value
NL	SEPL	Plastic yield stress
	SRAT	Plastic yielding (1 = actively yielding, 0 = not yielding)
	HPRES	Hydrostatic pressure
	EPEQ	Accumulated equivalent plastic strain
	CREQ	Accumulated equivalent creep strain
	PLWK	Plastic work/volume
YSIDX	TENS,SHEA	Yield surface activity status: 1 for yielded and 0 for not yielded.
FPIDX	TF01,SF01, TF02,SF02, TF03,SF03, TF04,SF04	Failure plane surface activity status: 1 for yielded and 0 for not yielded. Tension and Shear failure status are available for all four sets of failure planes.

*GET Postprocessing Items, Entity = SECTION

Entity = SECTION, ENTNUM = component (listed below). Generate data for section stress results, using prsect before retrieving these items. Valid labels for ENTNUM are MEMBRANE, BENDING, SUM (Membrane+Bending), PEAK, and TOTAL. (The following items are not stored in the database and the values returned reflect the last quantities generated by prsect or plsect.) Only MEMBRANE, BENDING, and SUM data are available after a plsect command. The MEMBRANE label is only valid with Item1 = INSIDE.

get, Par, SECTION, component, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Item2	Description
INSIDE	S	X, Y, Z, XY, YZ, XZ	Stress component at beginning of path.
		1, 2, 3	Principal stress at beginning of path.
		INT, EQV	Stress intensity or equivalent stress at beginning of path.
CENTER	S	X, Y, Z, XY, YZ, XZ	Stress component at midpoint of path.
		1, 2, 3	Principal stress at midpoint of path.
		INT, EQV	Stress intensity or equivalent stress at midpoint of path.
OUTSIDE	S	X, Y, Z, XY, YZ, XZ	Stress component at end of path.
		1, 2, 3	Principal stress at end of path.
		INT, EQV	Stress intensity or equivalent stress at end of path.

*GET Postprocessing Items, Entity = SORT

Entity = SORT, ENTNUM = 0 (or blank)

get, Par, SORT, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
MAX		Maximum value of last sorted item ( nsort or esort command).
MIN		Minimum value of last sorted item ( nsort or esort command).
IMAX		Node/Element number where maximum value occurs.
IMIN		Node/Element number where minimum value occurs.

*GET Postprocessing Items, Entity = SSUM

Entity = SSUM, ENTNUM = 0 (or blank)

get, Par, SSUM, 0, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
ITEM	Lab	Value of item Lab from last ssum command. Valid labels are the user-defined labels on the etable command.

*GET Postprocessing Items, Entity = VARI

Entity = VARI, ENTNUM = N (variable number after POST26 data storage) (for complex values, only the real part is returned with Item1 = EXTREM)

get, Par,VARI,N, Item1, IT1NUM, Item2, IT2NUM
Item1	IT1NUM	Description
EXTREM	VMAX	Maximum extreme value.
	TMAX	Time or frequency corresponding to VMAX.
	VMIN	Minimum extreme value.
	TMIN	Time or frequency corresponding to VMIN.
	VLAST	Last value.
	TLAST	Time or frequency corresponding to VLAST.
	CVAR	Covariance
REAL	f	Real part of variable N at time or frequency f.
IMAG	f	Imaginary part of variable N at frequency f.
AMPL	f	Amplitude value of variable N at frequency f
PHASE	f	Phase angle value of variable N at frequency f
RSET	Snum	Real part of variable N at location Snum.
ISET	Snum	Imaginary part of variable N at location Snum.

*GET Postprocessing Items, Entity = XFEM

Entity = XFEM, ENTNUM = 0 (or blank)

get, Par, XFEM, 0, Item1, IT1NUM
Item1	IT1NUM	Description
STAT	Element Number	Status of the element: 0 = uncracked, 1 = cracked