Using Inline Functions (Query)

This example shows you how to use the inline functions in PyMAPDL.

Inline functions like UX have been implemented in PyMAPDL as methods on the mapdl.inline_functions.Query object. In this example we set up a simple simulation and use Query to demonstrate some of its functionality.

First, get an instance of ansys.mapdl.core.inline_functions.Query below, using the mapdl property queries.

from ansys.mapdl.core import launch_mapdl

mapdl = launch_mapdl()

# clear at the start and enter the preprocessing routine
mapdl.clear()
mapdl.prep7()
q = mapdl.queries

Setup Mesh

• Assign element type SOLID5 to element type 1

• Create a cuboid mapdl.block 10 x 20 x 30 in dimension

• Set element size to 2

• Mesh the block

• Plot the elements created

mapdl.et(1, "SOLID5")
mapdl.block(0, 10, 0, 20, 0, 30)
mapdl.esize(2)
mapdl.vmesh("ALL")
mapdl.eplot()

Setup Boundary Conditions

• Assign an Elastic modulus in the x-direction to material 1 of 21e9

• And a poisson’s ratio of 0.3

• Select all nodes at the z = 30 end of the block

• Remove all degrees of freedom for all nodes in the selection

• Select all nodes at the z = 0 end

• Apply a x-direction force of 10000 to all of these

• Finish preprocessing

mapdl.mp("EX", 1, 210e9)
mapdl.mp("PRXY", 1, 0.3)
mapdl.nsel("S", "LOC", "Z", 30)
mapdl.d("ALL", "UX")
mapdl.d("ALL", "UY")
mapdl.d("ALL", "UZ")
mapdl.nsel("S", "LOC", "Z", 0)
mapdl.f("ALL", "FX", 10000)
mapdl.finish()

***** ROUTINE COMPLETED *****  CP =         0.000

Setup Boundary Conditions

• Enter solution (mapdl.slashsolu also works)

• Set the analysis type to STATIC

• Select all nodes

• Solve the model

• Finish solution

mapdl.run("/SOLU")
mapdl.antype("STATIC")
mapdl.allsel()
mapdl.solve()
mapdl.finish(mute=True)

Post-Processing

• Get the result from the mapdl instance

• Plot the equivalent stress results - Show the edges so that we can see the element boundaries - Use the “plasma” colormap because it is perceptually uniform

result = mapdl.result
result.plot_principal_nodal_stress(0, "SEQV", show_edges=True, cmap="plasma")

Using Query

• Use Query to get the nodes nearest to (5, 0, 0) and (5, 10, 0)

• Use the Query instance to examine the x, y, and z displacement.

• Print the results in a formatted string.

node1 = q.node(5.0, 0.0, 0.0)
node2 = q.node(5.0, 10.0, 0.0)

for node in [node1, node2]:
    x_displacement = q.ux(node)
    y_displacement = q.uy(node)
    z_displacement = q.uz(node)

    message = f"""
    ************************
    Displacement at Node {node}:
    ************************
    X | {x_displacement}
    Y | {y_displacement}
    Z | {z_displacement}

    """
    print(message)

************************
Displacement at Node 28:
************************
X | 1.757716378392376e-05
Y | 3.0362575468364524e-09
Z | -7.982690758479145e-07



************************
Displacement at Node 48:
************************
X | 1.7612417675181977e-05
Y | 6.662876485413412e-21
Z | -8.070989838528192e-07

Stop mapdl

mapdl.exit()