Translate scripts#
The ansys-mapdl-core library contains a few basic functions to translate existing MAPDL scripts into PyMAPDL scripts. Ideally, all math and variable setting would take place within Python because APDL commands are less transparent and more difficult to debug.
Usage#
You can call this command from the terminal with different
arguments. Here is an example that converts the mapdl.dat
file to a Python file named python.py:
$ pymapdl convert mapdl.dat -o python.py
File mapdl.dat successfully converted to python.py.
The output argument is completely optional. If you don’t specify it,
the py extension is used for the file that is outputted:
$ pymapdl convert mapdl.dat
File mapdl.dat successfully converted to mapdl.py.
You can use any option from the
convert_script() function.
For example, to avoid exiting the MAPDL instance after running
the script, you can use --auto-exit argument:
$ pymapdl convert mapdl.dat --auto-exit False
File mapdl.dat successfully converted to mapdl.py.
You can skip the imports by setting the --add_imports option
to False:
$ pymapdl convert mapdl.dat --filename_out mapdl.out --add_imports
False
File mapdl.dat successfully converted to mapdl.out.
For more information about possible options, use the help
command (pymapdl convert --help) or the
convert_script()
function documentation.
Caveats#
These examples only show an automatic translation of a verification:
file and not optimized code. Should it be necessary to pull
parameters or arrays from ansys, use the
Mapdl.get_value() function,
which is quite similar to the MAPDL
Mapdl.get() command shown here:
>>> mapdl.get_value("NODE", 2, "U", "Y")
4.532094298033
Alternatively, if a parameter is already defined, you can access it
using the Mapdl.parameters attribute
with:
>>> mapdl.parameters
ARR : ARRAY DIM (3, 1, 1)
PARM_FLOAT : 20.0
PARM_INT : 10.0
PARM_LONG_STR : "stringstringstringstringstringst"
PARM_STR : "string"
DEF_Y : 4.532094298033
>>> mapdl.parameters["DEF_Y"]
4.532094298033
Script translation#
Existing Ansys scripts can be translated using the convert_script()
function:
>>> import ansys.mapdl.core as pymapdl
>>> inputfile = "ansys_inputfile.inp"
>>> pyscript = "pyscript.py"
>>> pymapdl.convert_script(inputfile, pyscript)
Or, you can convert code in form of strings for later processing using the
convert_apdl_block() function:
from ansys.mapdl.core.convert import convert_apdl_block
apdl_string = """/com, This is a block of APDL commands.
/PREP7
N,,0,0,0
N,,0,0,1
FINISH"""
pycode = convert_apdl_block(apdl_string) # apdl_string can be also a list of strings.
The script conversion functions allow some interesting arguments, which you can see in
the respective convert_script()
and convert_apdl_block()
function documentation. Especially interesting are the add_imports, comment_solve,
and print_com keyword arguments.
Of particular note in the following examples is how most of the commands can be called
as a method to the Ansys object rather than sending a string as a command. Additionally,
take note that some commands require the
Mapdl.non_interactive
context manager since some commands require and may break the server connection for some
interfaces (such as CORBA) or are invalid (as in gRPC).
Also note that APDL macros that use *CREATE have been replaced
with Python functions. This makes the code easier to debug
should it be necessary to insert a breakpoint() in the script.
Example: VM1 - statically indeterminate reaction force analysis#
Ansys MAPDL contains over 200 verification files used for Ansys
validation and demonstration. These validation files are used here to
demo the use of the PyMAPDL file translator convert_script() function and are available in:
>>> from ansys.mapdl.core import examples
>>> examples.vmfiles["vm1"]
'.../ansys/mapdl/core/examples/verif/vm1.dat'
This example translates the verification example "vm1.dat",
which can be done with:
>>> from ansys.mapdl import core as pymapdl
>>> pymapdl.convert_script(examples.vmfiles["vm1"], "vm1.py")
Here is the MAPDL code:
/COM, 'ANSYS MEDIA REL. 150 (11/8/2013) REF. VERIF. MANUAL: REL. 150'
/VERIFY, VM1
/PREP7
/TITLE,' VM1, STATICALLY INDETERMINATE REACTION FORCE ANALYSIS'
/COM,' STR. OF MATL., TIMOSHENKO, PART 1, 3RD ED., PAGE 26, PROB.10'
ANTYPE, STATIC ! STATIC ANALYSIS
ET, 1, LINK180
SECTYPE, 1, LINK
SECDATA, 1 ! CROSS SECTIONAL AREA (ARBITRARY) = 1
MP, EX, 1, 30E6
N, 1
N, 2, , 4
N, 3, , 7
N, 4, , 10
E, 1, 2 ! DEFINE ELEMENTS
EGEN, 3, 1, 1
D, 1, ALL, , , 4, 3 ! BOUNDARY CONDITIONS AND LOADING
F, 2, FY, -500
F, 3, FY, -1000
FINISH
/SOLU
OUTPR, BASIC, 1
OUTPR, NLOAD, 1
SOLVE
FINISH
/POST1
NSEL, S, LOC, Y, 10
FSUM
*GET, REAC_1, FSUM, , ITEM, FY
NSEL, S, LOC, Y, 0
FSUM
*GET, REAC_2, FSUM, , ITEM, FY
*DIM, LABEL, CHAR, 2
*DIM, VALUE, , 2, 3
LABEL(1) = 'R1, lb', 'R2, lb '
*VFILL, VALUE(1, 1), DATA, 900.0, 600.0
*VFILL, VALUE(1, 2), DATA, ABS(REAC_1), ABS(REAC_2)
*VFILL, VALUE(1, 3), DATA, ABS(REAC_1 / 900) , ABS( REAC_2 / 600)
/OUT, vm1, vrt
/COM
/COM,' ------------------- VM1 RESULTS COMPARISON - --------------------'
/COM,
/COM,' | TARGET | Mechanical APDL | RATIO'
/COM,
*VWRITE, LABEL(1), VALUE(1, 1), VALUE(1, 2), VALUE(1, 3)
(1X, A8, ' ', F10.1, ' ', F10.1, ' ', 1F5.3)
/COM, ----------------------------------------------------------------
/OUT
FINISH
*LIST, vm1, vrt
""" Script generated by ansys-mapdl-core version 0.57.0"""
from ansys.mapdl.core import launch_mapdl
mapdl = launch_mapdl()
mapdl.run("/COM,ANSYS MEDIA REL. 150 (11/8/2013) REF. VERIF. MANUAL: REL. 150")
mapdl.run("/VERIFY,VM1")
mapdl.run("/PREP7")
mapdl.run("/TITLE, VM1, STATICALLY INDETERMINATE REACTION FORCE ANALYSIS")
mapdl.run("C*** STR. OF MATL., TIMOSHENKO, PART 1, 3RD ED., PAGE 26, PROB.10")
mapdl.antype("STATIC") # STATIC ANALYSIS
mapdl.et(1, "LINK180")
mapdl.sectype(1, "LINK")
mapdl.secdata(1) # CROSS SECTIONAL AREA (ARBITRARY) = 1
mapdl.mp("EX", 1, 30e6)
mapdl.n(1)
mapdl.n(2, "", 4)
mapdl.n(3, "", 7)
mapdl.n(4, "", 10)
mapdl.e(1, 2) # DEFINE ELEMENTS
mapdl.egen(3, 1, 1)
mapdl.d(1, "ALL", "", "", 4, 3) # BOUNDARY CONDITIONS AND LOADING
mapdl.f(2, "FY", -500)
mapdl.f(3, "FY", -1000)
mapdl.finish()
mapdl.run("/SOLU")
mapdl.outpr("BASIC", 1)
mapdl.outpr("NLOAD", 1)
mapdl.solve()
mapdl.finish()
mapdl.run("/POST1")
mapdl.nsel("S", "LOC", "Y", 10)
mapdl.fsum()
mapdl.run("*GET,REAC_1,FSUM,,ITEM,FY")
mapdl.nsel("S", "LOC", "Y", 0)
mapdl.fsum()
mapdl.run("*GET,REAC_2,FSUM,,ITEM,FY")
mapdl.run("*DIM,LABEL,CHAR,2")
mapdl.run("*DIM,VALUE,,2,3")
mapdl.run("LABEL(1) = 'R1, lb','R2, lb '")
mapdl.run("*VFILL,VALUE(1,1),DATA,900.0,600.0")
mapdl.run("*VFILL,VALUE(1,2),DATA,ABS(REAC_1),ABS(REAC_2)")
mapdl.run("*VFILL,VALUE(1,3),DATA,ABS(REAC_1 / 900) ,ABS( REAC_2 / 600)")
mapdl.run("/OUT,vm1,vrt")
mapdl.run("/COM")
mapdl.run("/COM,------------------- VM1 RESULTS COMPARISON ---------------------")
mapdl.run("/COM,")
mapdl.run("/COM, | TARGET | Mechanical APDL | RATIO")
mapdl.run("/COM,")
with mapdl.non_interactive:
mapdl.run("*VWRITE,LABEL(1),VALUE(1,1),VALUE(1,2),VALUE(1,3)")
mapdl.run("(1X,A8,' ',F10.1,' ',F10.1,' ',1F5.3)")
mapdl.run("/COM,----------------------------------------------------------------")
mapdl.run("/OUT")
mapdl.finish()
mapdl.run("*LIST,vm1,vrt")
mapdl.exit()
Note that some of the commands with / are not directly translated
to functions and are instead run as “classic” commands like
mapdl.run('/COM'). Also, note that the *VWRITE command
requires a command immediately following it. This normally locks the
interface, so it’s implemented in the background as an input file
using the Mapdl.non_interactive
attribute.
Here is the obtained result:
------------------- VM1 RESULTS COMPARISON ---------------------
| TARGET | Mechanical APDL | RATIO
/INPUT FILE= LINE= 0
R1, lb 900.0 900.0 1.000
R2, lb 600.0 600.0 1.000
----------------------------------------------------------------
You can verify the reaction forces with:
>>> rst = mapdl.result
>>> nnum, forces = rst.nodal_static_forces(0)
>>> print(forces)
[[ 0. -600. 0.]
[ 0. 250. 0.]
[ 0. 500. 0.]
[ 0. -900. 0.]]
Example: VM7 - plastic compression of a pipe assembly#
Convert the verification file with:
>>> from ansys.mapdl import core as pymapdl
>>> pymapdl.convert_script("path/to/vm7.dat", "path/to/output/vm7.py")
Here is the input file from VM7:
/COM,'ANSYS MEDIA REL. 150 (11/8/2013) REF. VERIF. MANUAL: REL. 150'
/VERIFY,VM7
/PREP7
/TITLE,' VM7, PLASTIC COMPRESSION OF A PIPE ASSEMBLY'
/COM,' MECHANICS OF SOLIDS, CRANDALL AND DAHL, 1959, PAGE 180, EX. 5.1'
/COM,' USING PIPE288, SOLID185 AND SHELL181 ELEMENTS'
THETA=6 ! SUBTENDED ANGLE
ET,1,PIPE288,,,,2
ET,2,SOLID185
ET,3,SHELL181,,,2 ! FULL INTEGRATION
SECTYPE,1,SHELL
SECDATA,0.5,1,0,5 ! THICKNESS (SHELL181)
SECTYPE,2,SHELL
SECDATA,0.5,2,0,5 ! THICKNESS (SHELL181)
SECTYPE,3,PIPE
SECDATA,4.9563384,0.5 ! OUTSIDE DIA. AND WALL THICKNESS FOR INSIDE TUBE (PIPE288)
SECTYPE,4,PIPE
SECDATA,8.139437,0.5 ! OUTSIDE DIA. AND WALL THICKNESS FOR OUTSIDE TUBE (PIPE288)
MP,EX ,1,26.875E6 ! STEEL
MP,PRXY,1,0.3
MP,EX ,2,11E6 ! ALUMINUM
MP,PRXY,2,0.3
TB,BKIN,1,1 ! DEFINE NON-LINEAR MATERIAL PROPERTY FOR STEEL
TBTEMP,0
TBDATA,1,86000,0
TB,BKIN,2,1 ! DEFINE NON-LINEAR MATERIAL PROPERTY FOR ALUMINUM
TBTEMP,0
TBDATA,1,55000,0
N,1 ! GENERATE NODES AND ELEMENTS FOR PIPE288
N,2,,,10
MAT,1
SECNUM,3 ! STEEL (INSIDE) TUBE
E,1,2
MAT,2
SECNUM,4 ! ALUMINUM (OUTSIDE) TUBE
E,1,2
CSYS,1
N,101,1.9781692 ! GENERATE NODES AND ELEMENTS FOR SOLID185
N,102,2.4781692
N,103,3.5697185
N,104,4.0697185
N,105,1.9781692,,10
N,106,2.4781692,,10
N,107,3.5697185,,10
N,108,4.0697185,,10
NGEN,2,10,101,108,,,THETA ! GENERATE 2ND SET OF NODES TO FORM A THETA DEGREE SLICE
NROTAT,101,118,1
TYPE,2
MAT,1 ! INSIDE (STEEL) TUBE
E,101,102,112,111,105,106,116,115
MAT,2 ! OUTSIDE (ALUMINUM) TUBE
E,103,104,114,113,107,108,118,117
N,201,2.2281692 ! GENERATE NODES AND ELEMENTS FOR SHELL181
N,203,2.2281692,,10
N,202,3.8197185
N,204,3.8197185,,10
NGEN,2,4,201,204,,,THETA ! GENERATE NODES TO FORM A THETA DEGREE SLICE
TYPE,3
SECNUM,1 ! INSIDE (STEEL) TUBE
E,203,201,205,207
SECNUM,2 ! OUTSIDE (ALUMINUM) TUBE
E,204,202,206,208
/COM,' APPLY CONSTRAINTS TO PIPE288 MODEL'
D,1,ALL ! FIX ALL DOFS FOR BOTTOM END OF PIPE288
D,2,UX,,,,,UY,ROTX,ROTY,ROTZ ! ALLOW ONLY UZ DOF AT TOP END OF PIPE288 MODEL
/COM,' APPLY CONSTRAINTS TO SOLID185 AND SHELL181 MODELS'
CP,1,UX,101,111,105,115 ! COUPLE NODES AT BOUNDARY IN RADIAL DIR FOR SOLID185
CPSGEN,4,,1
CP,5,UX,201,205,203,20 ! COUPLE NODES AT BOUNDARY IN RADIAL DIR FOR SHELL181
CPSGEN,2,,5
CP,7,ROTY,201,205 ! COUPLE NODES AT BOUNDARY IN ROTY DIR FOR SHELL181
CPSGEN,4,,7
NSEL,S,NODE,,101,212 ! SELECT ONLY NODES IN SOLID185 AND SHELL181 MODELS
NSEL,R,LOC,Y,0 ! SELECT NODES AT THETA = 0 FROM THE SELECTED SET
DSYM,SYMM,Y,1 ! APPLY SYMMETRY BOUNDARY CONDITIONS
NSEL,S,NODE,,101,212 ! SELECT ONLY NODES IN SOLID185 AND SHELL181 MODELS
NSEL,R,LOC,Y,THETA ! SELECT NODES AT THETA FROM THE SELECTED SET
DSYM,SYMM,Y,1 ! APPLY SYMMETRY BOUNDARY CONDITIONS
NSEL,ALL
NSEL,R,LOC,Z,0 ! SELECT ONLY NODES AT Z = 0
D,ALL,UZ,0 ! CONSTRAIN BOTTOM NODES IN Z DIRECTION
NSEL,ALL
FINISH
/SOLU
OUTPR,BASIC,LAST ! PRINT BASIC SOLUTION AT END OF LOAD STEP
/COM,' APPLY DISPLACEMENT LOADS TO ALL MODELS'
*CREATE,DISP
NSEL,R,LOC,Z,10 ! SELECT NODES AT Z = 10 TO APPLY DISPLACEMENT
D,ALL,UZ,ARG1
NSEL,ALL
/OUT,SCRATCH
SOLVE
*END
*USE,DISP,-.032
*USE,DISP,-.05
*USE,DISP,-.1
FINISH
/OUT,
/POST1
/COM,' CREATE MACRO TO GET RESULTS FOR EACH MODEL'
*CREATE,GETLOAD
NSEL,S,NODE,,1,2 ! SELECT NODES IN PIPE288 MODEL
NSEL,R,LOC,Z,0
/OUT,SCRATCH
FSUM ! FZ IS TOTAL LOAD FOR PIPE288 MODEL
*GET,LOAD_288,FSUM,,ITEM,FZ
NSEL,S,NODE,,101,118 ! SELECT NODES IN SOLID185 MODEL
NSEL,R,LOC,Z,0
FSUM
*GET,ZFRC,FSUM,0,ITEM,FZ
LOAD=ZFRC*360/THETA ! MULTIPLY BY 360/THETA FOR FULL 360 DEGREE RESULTS
*STATUS,LOAD
LOAD_185 = LOAD
NSEL,S,NODE,,201,212 ! SELECT NODES IN SHELL181 MODEL
NSEL,R,LOC,Z,0
FSUM
/OUT,
*GET,ZFRC,FSUM,0,ITEM,FZ
LOAD=ZFRC*360/THETA ! MULTIPLY BY 360/THETA FOR FULL 360 DEGREE RESULTS
*STATUS,LOAD
LOAD_181 = LOAD
*VFILL,VALUE_288(1,1),DATA,1024400,1262000,1262000
*VFILL,VALUE_288(I,2),DATA,ABS(LOAD_288)
*VFILL,VALUE_288(I,3),DATA,ABS(LOAD_288)/(VALUE_288(I,1))
*VFILL,VALUE_185(1,1),DATA,1024400,1262000,1262000
*VFILL,VALUE_185(J,2),DATA,ABS(LOAD_185)
*VFILL,VALUE_185(J,3),DATA,ABS(LOAD_185)/(VALUE_185(J,1))
*VFILL,VALUE_181(1,1),DATA,1024400,1262000,1262000
*VFILL,VALUE_181(K,2),DATA,ABS(LOAD_181)
*VFILL,VALUE_181(K,3),DATA,ABS(LOAD_181)/(VALUE_181(K,1))
*END
/COM,' GET TOTAL LOAD FOR DISPLACEMENT = 0.032'
/COM,' ---------------------------------------'
SET,1,1
I = 1
J = 1
K = 1
*DIM,LABEL,CHAR,3,2
*DIM,VALUE_288,,3,3
*DIM,VALUE_185,,3,3
*DIM,VALUE_181,,3,3
*USE,GETLOAD
/COM,' GET TOTAL LOAD FOR DISPLACEMENT = 0.05'
/COM,' --------------------------------------'
SET,2,1
I = I + 1
J = J + 1
K = K + 1
*USE,GETLOAD
/COM,' GET TOTAL LOAD FOR DISPLACEMENT = 0.1'
/COM,' -------------------------------------'
SET,3,1
I = I +1
J = J + 1
K = K + 1
*USE,GETLOAD
LABEL(1,1) = 'LOAD, lb','LOAD, lb','LOAD, lb'
LABEL(1,2) = ' UX=.032',' UX=0.05',' UX=0.10'
FINISH
/OUT,vm7,vrt
/COM,------------------- VM7 RESULTS COMPARISON ---------------------
/COM,
/COM,' | TARGET | Mechanical APDL | RATIO'
/COM,
/COM,RESULTS FOR PIPE288:
/COM,
*VWRITE,LABEL(1,1),LABEL(1,2),VALUE_288(1,1),VALUE_288(1,2),VALUE_288(1,3)
(1X,A8,A8,' ',F10.0,' ',F14.0,' ',1F15.3)
/COM,
/COM,RESULTS FOR SOLID185:
/COM,
*VWRITE,LABEL(1,1),LABEL(1,2),VALUE_185(1,1),VALUE_185(1,2),VALUE_185(1,3)
(1X,A8,A8,' ',F10.0,' ',F14.0,' ',1F15.3)
/COM,
/COM,RESULTS FOR SHELL181:
/COM,
*VWRITE,LABEL(1,1),LABEL(1,2),VALUE_181(1,1),VALUE_181(1,2),VALUE_181(1,3)
(1X,A8,A8,' ',F10.0,' ',F14.0,' ',1F15.3)
/COM,
/COM,-----------------------------------------------------------------
/OUT
*LIST,vm7,vrt
from ansys.mapdl.core import launch_mapdl
mapdl = launch_mapdl()
mapdl.run("/COM,ANSYS MEDIA REL. 150 (11/8/2013) REF. VERIF. MANUAL: REL. 150")
mapdl.run("/VERIFY,VM7")
mapdl.run("/PREP7")
mapdl.run("/TITLE, VM7, PLASTIC COMPRESSION OF A PIPE ASSEMBLY")
mapdl.run(
"C*** MECHANICS OF SOLIDS, CRANDALL AND DAHL, 1959, PAGE 180, EX. 5.1"
)
mapdl.run("C*** USING PIPE288, SOLID185 AND SHELL181 ELEMENTS")
mapdl.run("THETA=6 ") # SUBTENDED ANGLE
mapdl.et(1, "PIPE288", "", "", "", 2)
mapdl.et(2, "SOLID185")
mapdl.et(3, "SHELL181", "", "", 2) # FULL INTEGRATION
mapdl.sectype(1, "SHELL")
mapdl.secdata(0.5, 1, 0, 5) # THICKNESS (SHELL181)
mapdl.sectype(2, "SHELL")
mapdl.secdata(0.5, 2, 0, 5) # THICKNESS (SHELL181)
mapdl.sectype(3, "PIPE")
mapdl.secdata(
4.9563384, 0.5
) # OUTSIDE DIA. AND WALL THICKNESS FOR INSIDE TUBE (PIPE288)
mapdl.sectype(4, "PIPE")
mapdl.secdata(
8.139437, 0.5
) # OUTSIDE DIA. AND WALL THICKNESS FOR OUTSIDE TUBE (PIPE288)
mapdl.mp("EX", 1, 26.875e6) # STEEL
mapdl.mp("PRXY", 1, 0.3)
mapdl.mp("EX", 2, 11e6) # ALUMINUM
mapdl.mp("PRXY", 2, 0.3)
mapdl.tb("BKIN", 1, 1) # DEFINE NON-LINEAR MATERIAL PROPERTY FOR STEEL
mapdl.tbtemp(0)
mapdl.tbdata(1, 86000, 0)
mapdl.tb("BKIN", 2, 1) # DEFINE NON-LINEAR MATERIAL PROPERTY FOR ALUMINUM
mapdl.tbtemp(0)
mapdl.tbdata(1, 55000, 0)
mapdl.n(1) # GENERATE NODES AND ELEMENTS FOR PIPE288
mapdl.n(2, "", "", 10)
mapdl.mat(1)
mapdl.secnum(3) # STEEL (INSIDE) TUBE
mapdl.e(1, 2)
mapdl.mat(2)
mapdl.secnum(4) # ALUMINUM (OUTSIDE) TUBE
mapdl.e(1, 2)
mapdl.csys(1)
mapdl.n(101, 1.9781692) # GENERATE NODES AND ELEMENTS FOR SOLID185
mapdl.n(102, 2.4781692)
mapdl.n(103, 3.5697185)
mapdl.n(104, 4.0697185)
mapdl.n(105, 1.9781692, "", 10)
mapdl.n(106, 2.4781692, "", 10)
mapdl.n(107, 3.5697185, "", 10)
mapdl.n(108, 4.0697185, "", 10)
mapdl.ngen(
2, 10, 101, 108, "", "", "THETA"
) # GENERATE 2ND SET OF NODES TO FORM A THETA DEGREE SLICE
mapdl.nrotat(101, 118, 1)
mapdl.type(2)
mapdl.mat(1) # INSIDE (STEEL) TUBE
mapdl.e(101, 102, 112, 111, 105, 106, 116, 115)
mapdl.mat(2) # OUTSIDE (ALUMINUM) TUBE
mapdl.e(103, 104, 114, 113, 107, 108, 118, 117)
mapdl.n(201, 2.2281692) # GENERATE NODES AND ELEMENTS FOR SHELL181
mapdl.n(203, 2.2281692, "", 10)
mapdl.n(202, 3.8197185)
mapdl.n(204, 3.8197185, "", 10)
mapdl.ngen(
2, 4, 201, 204, "", "", "THETA"
) # GENERATE NODES TO FORM A THETA DEGREE SLICE
mapdl.type(3)
mapdl.secnum(1) # INSIDE (STEEL) TUBE
mapdl.e(203, 201, 205, 207)
mapdl.secnum(2) # OUTSIDE (ALUMINUM) TUBE
mapdl.e(204, 202, 206, 208)
mapdl.run("C*** APPLY CONSTRAINTS TO PIPE288 MODEL")
mapdl.d(1, "ALL") # FIX ALL DOFS FOR BOTTOM END OF PIPE288
mapdl.d(
2, "UX", "", "", "", "", "UY", "ROTX", "ROTY", "ROTZ"
) # ALLOW ONLY UZ DOF AT TOP END OF PIPE288 MODEL
mapdl.run("C*** APPLY CONSTRAINTS TO SOLID185 AND SHELL181 MODELS")
mapdl.cp(
1, "UX", 101, 111, 105, 115
) # COUPLE NODES AT BOUNDARY IN RADIAL DIR FOR SOLID185
mapdl.cpsgen(4, "", 1)
mapdl.cp(
5, "UX", 201, 205, 203, 20
) # COUPLE NODES AT BOUNDARY IN RADIAL DIR FOR SHELL181
mapdl.cpsgen(2, "", 5)
mapdl.cp(7, "ROTY", 201, 205) # COUPLE NODES AT BOUNDARY IN ROTY DIR FOR SHELL181
mapdl.cpsgen(4, "", 7)
mapdl.nsel(
"S", "NODE", "", 101, 212
) # SELECT ONLY NODES IN SOLID185 AND SHELL181 MODELS
mapdl.nsel("R", "LOC", "Y", 0) # SELECT NODES AT THETA = 0 FROM THE SELECTED SET
mapdl.dsym("SYMM", "Y", 1) # APPLY SYMMETRY BOUNDARY CONDITIONS
mapdl.nsel(
"S", "NODE", "", 101, 212
) # SELECT ONLY NODES IN SOLID185 AND SHELL181 MODELS
mapdl.nsel("R", "LOC", "Y", "THETA") # SELECT NODES AT THETA FROM THE SELECTED SET
mapdl.dsym("SYMM", "Y", 1) # APPLY SYMMETRY BOUNDARY CONDITIONS
mapdl.nsel("ALL")
mapdl.nsel("R", "LOC", "Z", 0) # SELECT ONLY NODES AT Z = 0
mapdl.d("ALL", "UZ", 0) # CONSTRAIN BOTTOM NODES IN Z DIRECTION
mapdl.nsel("ALL")
mapdl.finish()
mapdl.run("/SOLU")
mapdl.outpr("BASIC", "LAST") # PRINT BASIC SOLUTION AT END OF LOAD STEP
mapdl.run("C*** APPLY DISPLACEMENT LOADS TO ALL MODELS")
def DISP(
ARG1="",
ARG2="",
ARG3="",
ARG4="",
ARG5="",
ARG6="",
ARG7="",
ARG8="",
ARG9="",
ARG10="",
ARG11="",
ARG12="",
ARG13="",
ARG14="",
ARG15="",
ARG16="",
ARG17="",
ARG18="",
):
mapdl.nsel("R", "LOC", "Z", 10) # SELECT NODES AT Z = 10 TO APPLY DISPLACEMENT
mapdl.d("ALL", "UZ", ARG1)
mapdl.nsel("ALL")
mapdl.run("/OUT,SCRATCH")
mapdl.solve()
DISP(-0.032)
DISP(-0.05)
DISP(-0.1)
mapdl.finish()
mapdl.run("/OUT,")
mapdl.run("/POST1")
mapdl.run("C*** CREATE MACRO TO GET RESULTS FOR EACH MODEL")
def GETLOAD(
ARG1="",
ARG2="",
ARG3="",
ARG4="",
ARG5="",
ARG6="",
ARG7="",
ARG8="",
ARG9="",
ARG10="",
ARG11="",
ARG12="",
ARG13="",
ARG14="",
ARG15="",
ARG16="",
ARG17="",
ARG18="",
):
mapdl.nsel("S", "NODE", "", 1, 2) # SELECT NODES IN PIPE288 MODEL
mapdl.nsel("R", "LOC", "Z", 0)
mapdl.run("/OUT,SCRATCH")
mapdl.fsum() # FZ IS TOTAL LOAD FOR PIPE288 MODEL
mapdl.run("*GET,LOAD_288,FSUM,,ITEM,FZ")
mapdl.nsel("S", "NODE", "", 101, 118) # SELECT NODES IN SOLID185 MODEL
mapdl.nsel("R", "LOC", "Z", 0)
mapdl.fsum()
mapdl.run("*GET,ZFRC,FSUM,0,ITEM,FZ")
mapdl.run(
"LOAD=ZFRC*360/THETA "
) # MULTIPLY BY 360/THETA FOR FULL 360 DEGREE RESULTS
mapdl.run("*STATUS,LOAD")
mapdl.run("LOAD_185 = LOAD")
mapdl.nsel("S", "NODE", "", 201, 212) # SELECT NODES IN SHELL181 MODEL
mapdl.nsel("R", "LOC", "Z", 0)
mapdl.fsum()
mapdl.run("/OUT,")
mapdl.run("*GET,ZFRC,FSUM,0,ITEM,FZ")
mapdl.run(
"LOAD=ZFRC*360/THETA "
) # MULTIPLY BY 360/THETA FOR FULL 360 DEGREE RESULTS
mapdl.run("*STATUS,LOAD")
mapdl.run("LOAD_181 = LOAD")
mapdl.run("*VFILL,VALUE_288(1,1),DATA,1024400,1262000,1262000")
mapdl.run("*VFILL,VALUE_288(I,2),DATA,ABS(LOAD_288)")
mapdl.run("*VFILL,VALUE_288(I,3),DATA,ABS(LOAD_288)/(VALUE_288(I,1))")
mapdl.run("*VFILL,VALUE_185(1,1),DATA,1024400,1262000,1262000")
mapdl.run("*VFILL,VALUE_185(J,2),DATA,ABS(LOAD_185)")
mapdl.run("*VFILL,VALUE_185(J,3),DATA,ABS(LOAD_185)/(VALUE_185(J,1))")
mapdl.run("*VFILL,VALUE_181(1,1),DATA,1024400,1262000,1262000")
mapdl.run("*VFILL,VALUE_181(K,2),DATA,ABS(LOAD_181)")
mapdl.run("*VFILL,VALUE_181(K,3),DATA,ABS(LOAD_181)/(VALUE_181(K,1))")
mapdl.run("C*** GET TOTAL LOAD FOR DISPLACEMENT = 0.032")
mapdl.run("C*** ---------------------------------------")
mapdl.set(1, 1)
mapdl.run("I = 1")
mapdl.run("J = 1")
mapdl.run("K = 1")
mapdl.run("*DIM,LABEL,CHAR,3,2")
mapdl.run("*DIM,VALUE_288,,3,3")
mapdl.run("*DIM,VALUE_185,,3,3")
mapdl.run("*DIM,VALUE_181,,3,3")
GETLOAD()
mapdl.run("C*** GET TOTAL LOAD FOR DISPLACEMENT = 0.05")
mapdl.run("C*** --------------------------------------")
mapdl.set(2, 1)
mapdl.run("I = I + 1")
mapdl.run("J = J + 1")
mapdl.run("K = K + 1")
GETLOAD()
mapdl.run("C*** GET TOTAL LOAD FOR DISPLACEMENT = 0.1")
mapdl.run("C*** -------------------------------------")
mapdl.set(3, 1)
mapdl.run("I = I +1")
mapdl.run("J = J + 1")
mapdl.run("K = K + 1")
GETLOAD()
mapdl.run("LABEL(1,1) = 'LOAD, lb','LOAD, lb','LOAD, lb'")
mapdl.run("LABEL(1,2) = ' UX=.032',' UX=0.05',' UX=0.10'")
mapdl.finish()
mapdl.run("/OUT,vm7,vrt")
mapdl.run("/COM,------------------- VM7 RESULTS COMPARISON ---------------------")
mapdl.run("/COM,")
mapdl.run("/COM, | TARGET | Mechanical APDL | RATIO")
mapdl.run("/COM,")
mapdl.run("/COM,RESULTS FOR PIPE288:")
mapdl.run("/COM,")
with mapdl.non_interactive:
mapdl.run(
"*VWRITE,LABEL(1,1),LABEL(1,2),VALUE_288(1,1),VALUE_288(1,2),VALUE_288(1,3)"
)
mapdl.run("(1X,A8,A8,' ',F10.0,' ',F14.0,' ',1F15.3)")
mapdl.run("/COM,")
mapdl.run("/COM,RESULTS FOR SOLID185:")
mapdl.run("/COM,")
mapdl.run(
"*VWRITE,LABEL(1,1),LABEL(1,2),VALUE_185(1,1),VALUE_185(1,2),VALUE_185(1,3)"
)
mapdl.run("(1X,A8,A8,' ',F10.0,' ',F14.0,' ',1F15.3)")
mapdl.run("/COM,")
mapdl.run("/COM,RESULTS FOR SHELL181:")
mapdl.run("/COM,")
mapdl.run(
"*VWRITE,LABEL(1,1),LABEL(1,2),VALUE_181(1,1),VALUE_181(1,2),VALUE_181(1,3)"
)
mapdl.run("(1X,A8,A8,' ',F10.0,' ',F14.0,' ',1F15.3)")
mapdl.run("/COM,")
mapdl.run("/COM,-----------------------------------------------------------------")
mapdl.run("/OUT")
mapdl.run("*LIST,vm7,vrt")
mapdl.exit()