mopt

Mapdl.mopt(lab='', value='', **kwargs)

Specifies meshing options.

APDL Command: MOPT

Parameters:

lab

Meshing option to be specified (determines the meaning of Value):

AORDER - Mesh by ascending area size order. Set Value to ON to mesh smaller areas

first. Using this results in finer meshes in critical areas for volume meshes; this can be used for cases where SMRTSIZE does not mesh as needed. Default is OFF.

EXPND - Area mesh expansion (or contraction) option. (This option is the same as

SMRTSIZE,,,EXPND.) This option is used to size internal elements in an area based on the size of the elements on the area’s boundaries.

Value is the expansion (or contraction) factor. For example, issuing MOPT,EXPND,2 before meshing an area will allow a mesh with elements that are approximately twice as large in the interior of an area as they are on the boundary. If Value is less than 1, a mesh with smaller elements on the interior of the area will be allowed. Value for this option should be greater than 0.5 but less than 4. - Value defaults to 1, which does not allow expansion or contraction of internal

element sizes (except when using AESIZE sizing). If Value = 0, the default value of 1 will be used. The actual size of the internal elements will also depend on the TRANS option (or upon AESIZE or ESIZE sizing, if used).

TETEXPND - Tet-mesh expansion (or contraction) option. This option is used to size

internal elements in a volume based on the size of the elements on the volume’s boundaries.

Value is the expansion (or contraction) factor. For example, issuing MOPT,TETEXPND,2 before meshing a volume will allow a mesh with elements that are approximately twice as large in the interior of the volume as they are on the boundary. If Value is less than 1, a mesh with smaller elements on the interior of the volume will be allowed. Value for this option should be greater than 0.1 but less than 3. - Value defaults to 1, which does not allow expansion or contraction of internal

element sizes. If Value = 0, the default value of 1 will be used. If Value is greater than 2, mesher robustness may be affected.

The TETEXPND option is supported for both the VMESH and FVMESH commands. Tet-mesh expansion is the only mesh control supported by FVMESH. - TRANS

Mesh-transition option. Controls how rapidly elements are permitted to change in size from the boundary to the interior of an area. (This option performs the same operation as SMRTSIZE,,,,TRANS.) - Value is the transitioning factor. Value defaults to 2.0, which permits

elements to approximately double in size as they approach the interior of the area. (If Value = 0, the default value of 2 will be used.) Value must be greater than 1 and, for best results, should be less than 4. The actual size of the internal elements will also depend on the EXPND option (or upon AESIZE or ESIZE sizing, if used).

For a quad mesh with any element size, this option has no effect, as the program strictly respects any face size to ensure the most uniform quad mesh possible. To obtain a graded mesh using this option, apply LESIZE to the lines of the desired face. - AMESH

Triangle surface-meshing option. Valid inputs for Value are: - DEFAULT

Allows the program to choose which triangle mesher to use. In most cases, the program chooses the main triangle mesher, which is the Riemann space mesher. If the chosen mesher fails for any reason, the program invokes the alternate mesher and retries the meshing operation. - MAIN

The program uses the main triangle mesher (Riemann space mesher), and it does not invoke an alternate mesher if the main mesher fails. The Riemann space mesher is well suited for most surfaces. - ALTERNATE

The program uses the first alternate triangle mesher (3-D tri-mesher), and it does not invoke another mesher if this mesher fails. This option is not recommended due to speed considerations. However, for surfaces with degeneracies in parametric space, this mesher often provides the best results. - ALT2

The program uses the second alternate triangle mesher (2-D parametric space mesher), and it does not invoke another mesher if this mesher fails. This option is not recommended for use on surfaces with degeneracies (spheres, cones, etc.) or poorly parameterized surfaces because poor meshes may result. - QMESH

Quadrilateral surface meshing option. (Quadrilateral surface meshes will differ based on which triangle surface mesher is selected. This is true because all free quadrilateral meshing algorithms use a triangle mesh as a starting point.) Valid inputs for Value are: - DEFAULT

Let the program choose which quadrilateral mesher to use. In most cases, the program will choose the main quadrilateral mesher, which is the Q-Morph (quad-morphing) mesher. For very coarse meshes, the program may choose the alternate quadrilateral mesher instead. In most cases, the Q-Morph mesher results in higher quality elements. If either mesher fails for any reason, the program invokes the other mesher and retries the meshing operation. (Default.) - MAIN

The program uses the main quadrilateral mesher (Q-Morph mesher), and it does not invoke the alternate mesher if the main mesher fails. - ALTERNATE

The program uses the alternate quadrilateral mesher, and it does not invoke the Q-Morph mesher if the alternate mesher fails. To use the alternate quadrilateral mesher, you must also select MOPT,AMESH,ALTERNATE or MOPT,AMESH,ALT2. - VMESH

Tetrahedral element meshing option. Valid inputs for Value are: - DEFAULT

Let the program choose which tetrahedra mesher to use. - MAIN

Use the main tetrahedra mesher (Delaunay technique mesher). (GHS3D meshing technology by P. L. George, INRIA, France.) For most models, this mesher is significantly faster than the alternate mesher. - ALTERNATE

Use the alternate tetrahedra mesher (advancing front mesher). This mesher does not support the generation of a tetrahedral volume mesh from facets (FVMESH). If this mesher is selected and you issue the FVMESH command, the program uses the main tetrahedra mesher to create the mesh from facets and issues a warning message to notify you. - SPLIT

Quad splitting option for non-mapped meshing. If Value = 1, ON, or ERR, quadrilateral elements in violation of shape error limits are split into triangles (default). If Value = 2 or WARN, quadrilateral elements in violation of either shape error or warning limits are split into triangles. If Value = OFF, splitting does not occur, regardless of element quality. - LSMO

Line smoothing option. Value can be ON or OFF. If Value = ON, smoothing of nodes on area boundaries is performed during smoothing step of meshing. During smoothing, node locations are adjusted to achieve a better mesh. If Value = OFF (default), no smoothing takes place at area boundaries. - CLEAR

This option affects the element and node numbering after clearing a mesh. If Value = ON (default), the starting node and element numbers will be the lowest available number after the nodes and elements are cleared. If Value = OFF, the starting node and element numbers are not reset after the clear operation. - PYRA